Material¶

The Material commands are used to define the materials in a model.

Create materials¶

In Mdb¶

class MaterialModel( name, description='', stefanBoltzmann=None, absoluteZero=None, waveFormulation=NOT_SET, modelType=STANDARD_EXPLICIT, universalGas=None, copyConstraints=1, copyConnectors=1, copyInteractions=1, )[源代码]¶

基类：ModelBase

Abaqus creates a Model object named Model-1 when a session is started.

备注

This object can be accessed by:

mdb.models[name]

备注

Check MaterialModel on help.3ds.com/2017.

Public Data Attributes:

Inherited from ModelBase

`name`	A String specifying the repository key.
`stefanBoltzmann`	None or a Float specifying the Stefan-Boltzmann constant.
`absoluteZero`	None or a Float specifying the absolute zero constant.
`waveFormulation`	A SymbolicConstant specifying the type of incident wave formulation to be used in acoustic problems.
`universalGas`	None or a Float specifying the universal gas constant.
`noPartsInputFile`	A Boolean specifying whether an input file should be written without parts and assemblies.
`endRestartStep`	A Boolean specifying that the step specified by restartStep should be terminated at the increment specified by restartIncrement.
`shellToSolid`	A Boolean specifying that a shell global model drives a solid submodel.
`lastChangedCount`	A Float specifying the time stamp that indicates when the model was last changed.
`description`	A String specifying the purpose and contents of the Model object.
`restartJob`	A String specifying the name of the job that generated the restart data.
`restartStep`	A String specifying the name of the step where the restart analysis will start.
`globalJob`	A String specifying the name of the job that generated the results for the global model.
`copyConstraints`	A boolean specifying the status of constraints created in a model, in the model which instances this model.
`copyConnectors`	A boolean specifying the status of connectors created in a model, in the model which instances this model.
`copyInteractions`	A boolean specifying the status of interactions created in a model, in the model which instances this model.
`keywordBlock`	A KeywordBlock object.
`amplitudes`	A repository of Amplitude objects.
`profiles`	A repository of Profile objects.
`boundaryConditions`	A repository of BoundaryCondition objects.
`constraints`	A repository of ConstrainedSketchConstraint objects.
`analyticalFields`	A repository of AnalyticalField objects.
`discreteFields`	A repository of DiscreteField objects.
`predefinedFields`	A repository of PredefinedField objects.
`interactions`	A repository of Interaction objects.
`interactionProperties`	A repository of InteractionProperty objects.
`contactControls`	A repository of ContactControl objects.
`contactInitializations`	A repository of ContactInitialization objects.
`contactStabilizations`	A repository of ContactStabilization objects.
`linkedInstances`	A tuple of tuples of Strings specifying the linked child PartInstance name in the current model to the corresponding parent PartInstance name in a different model.
`linkedParts`	A tuple of tuples of Strings specifying the linked child Part name in the current model to the corresponding parent Part name in a different model.
`loads`	A repository of Load objects.
`materials`	A repository of Material objects.
`calibrations`	A repository of Calibration objects.
`sections`	A repository of Section objects.
`remeshingRules`	A repository of RemeshingRule objects.
`sketches`	A repository of ConstrainedSketch objects.
`parts`	A repository of Part objects.
`steps`	A repository of Step objects.
`featureOptions`	A FeatureOptions object.
`adaptiveMeshConstraints`	A repository of AdaptiveMeshConstraint objects.
`adaptiveMeshControls`	A repository of AdaptiveMeshControl objects.
`timePoints`	A repository of TimePoint objects.
`filters`	A repository of Filter objects.
`integratedOutputSections`	A repository of IntegratedOutputSection objects.
`fieldOutputRequests`	A repository of FieldOutputRequest objects.
`historyOutputRequests`	A repository of HistoryOutputRequest objects.
`optimizationTasks`	A repository of OptimizationTask objects.
`restartIncrement`	An Int specifying the increment, interval, iteration or cycle where the restart analysis will start.
`rootAssembly`	An Assembly object.

Public Methods:

`Material`(name[, description, materialIdentifier])	This method creates a Material object.

Inherited from ModelBase

`__init__`(name[, description, ...])	This method creates a Model object.
`ModelFromInputFile`(name, inputFileName)	This method creates a Model object by reading the keywords in an input file and creating the corresponding Abaqus/CAE objects.
`ModelFromOdbFile`(name, odbFileName)	This method creates a Model object by reading an output database and creating any corresponding Abaqus/CAE objects.
`ModelFromNastranFile`(modelName, inputFileName)	This method creates a Model object by reading the keywords in a Nastran bulk data file or Nastran input file and creating any corresponding Abaqus/CAE objects.
`setValues`([description, noPartsInputFile, ...])	This method modifies the Model object.

Member Details:

Material(name, description='', materialIdentifier='')[源代码]¶

This method creates a Material object.

备注

This function can be accessed by:

mdb.models[name].Material

备注

Check Material on help.3ds.com/2017.

参数:¶

name¶: A String specifying the name of the new material.
description=''¶: A String specifying user description of the material. The default value is an empty string.
materialIdentifier=''¶: A String specifying material identifier for customer use. The default value is an empty string.

返回:¶

A Material object.

返回类型:¶

Material

In Odb¶

class MaterialOdb(name, analysisTitle='', description='', path='')[源代码]¶

基类：OdbBase

The Odb object is the in-memory representation of an output database (ODB) file.

备注

This object can be accessed by:

import odbAccess
session.odbs[name]

备注

Check MaterialOdb on help.3ds.com/2017.

Public Data Attributes:

Inherited from OdbBase

`isReadOnly`	A Boolean specifying whether the output database was opened with read-only access.
`amplitudes`	A repository of Amplitude objects.
`filters`	A repository of Filter objects.
`rootAssembly`	An OdbAssembly object.
`jobData`	A JobData object.
`parts`	A repository of OdbPart objects.
`materials`	A repository of Material objects.
`steps`	A repository of OdbStep objects.
`sections`	A repository of Section objects.
`sectionCategories`	A repository of SectionCategory objects.
`sectorDefinition`	A SectorDefinition object.
`userData`	A UserData object.
`customData`	A RepositorySupport object.
`profiles`	A repository of Profile objects.

Public Methods:

`Material`(name[, description, materialIdentifier])	This method creates a Material object.

Inherited from OdbBase

`__init__`(name[, analysisTitle, description, ...])	This method creates a new Odb object.
`close`()	This method closes an output database.
`getFrame`(frameValue[, match])	This method returns the frame at the specified time, frequency, or mode.
`save`()	This method saves output to an output database (.odb ) file.
`update`()	This method is used to update an Odb object in memory while an Abaqus analysis writes data to the associated output database.

Member Details:

Material(name, description='', materialIdentifier='')[源代码]¶

This method creates a Material object.

备注

This function can be accessed by:

session.odbs[name].Material

备注

Check Material on help.3ds.com/2017.

参数:¶

name¶: A String specifying the name of the new material.
description=''¶: A String specifying user description of the material. The default value is an empty string.
materialIdentifier=''¶: A String specifying material identifier for customer use. The default value is an empty string.

返回:¶

A Material object.

返回类型:¶

Material

Assign properties to the material¶

class Material(name, description='', materialIdentifier='')[源代码]¶

基类：MaterialBase

A Material object is the object used to specify a material. The Material object stores the various settings that determine how a material behaves. A material is created by combining one or more individual material options and sub options. A particular material option is associated with the Material object through a member. For example: the acousticMedium member may contain an AcousticMedium object. The alternative of having a MaterialOption abstract base class and a container of MaterialOptions was rejected because it would make it more difficult to enforce the fact that one Material object cannot contain two AcousticMedium objects, for example.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name]
import odbMaterial
session.odbs[name].materials[name]

The corresponding analysis keywords are:

MATERIAL

备注

Check Material on help.3ds.com/2017.

Public Data Attributes:

Inherited from MaterialBase

`acousticMedium`	An AcousticMedium object.
`brittleCracking`	A BrittleCracking object.
`capPlasticity`	A CapPlasticity object.
`castIronPlasticity`	A CastIronPlasticity object.
`clayPlasticity`	A ClayPlasticity object.
`concrete`	A Concrete object.
`concreteDamagedPlasticity`	A ConcreteDamagedPlasticity object.
`conductivity`	A Conductivity object.
`creep`	A Creep object.
`crushableFoam`	A CrushableFoam object.
`ductileDamageInitiation`	A DamageInitiation object.
`fldDamageInitiation`	A DamageInitiation object.
`flsdDamageInitiation`	A DamageInitiation object.
`johnsonCookDamageInitiation`	A DamageInitiation object.
`maxeDamageInitiation`	A DamageInitiation object.
`maxsDamageInitiation`	A DamageInitiation object.
`maxpeDamageInitiation`	A DamageInitiation object.
`maxpsDamageInitiation`	A DamageInitiation object.
`mkDamageInitiation`	A DamageInitiation object.
`msfldDamageInitiation`	A DamageInitiation object.
`quadeDamageInitiation`	A DamageInitiation object.
`quadsDamageInitiation`	A DamageInitiation object.
`shearDamageInitiation`	A DamageInitiation object.
`hashinDamageInitiation`	A DamageInitiation object.
`damping`	A Damping object.
`deformationPlasticity`	A DeformationPlasticity object.
`density`	A Density object.
`depvar`	A Depvar object.
`dielectric`	A Dielectric object.
`diffusivity`	A Diffusivity object.
`druckerPrager`	A DruckerPrager object.
`elastic`	An Elastic object.
`electricalConductivity`	An ElectricalConductivity object.
`eos`	An Eos object.
`expansion`	An Expansion object.
`fluidLeakoff`	A FluidLeakoff object.
`gapFlow`	A GapFlow object.
`gasketThicknessBehavior`	A GasketThicknessBehavior object.
`gasketTransverseShearElastic`	A GasketTransverseShearElastic object.
`gasketMembraneElastic`	A GasketMembraneElastic object.
`gel`	A Gel object.
`heatGeneration`	A HeatGeneration object.
`hyperelastic`	A Hyperelastic object.
`hyperfoam`	A Hyperfoam object.
`hypoelastic`	A Hypoelastic object.
`inelasticHeatFraction`	An InelasticHeatFraction object.
`jouleHeatFraction`	A JouleHeatFraction object.
`latentHeat`	A LatentHeat object.
`lowDensityFoam`	A LowDensityFoam object.
`magneticPermeability`	A MagneticPermeability object.
`mohrCoulombPlasticity`	A MohrCoulombPlasticity object.
`moistureSwelling`	A MoistureSwelling object.
`mullinsEffect`	A MullinsEffect object.
`permeability`	A Permeability object.
`piezoelectric`	A Piezoelectric object.
`plastic`	A Plastic object.
`poreFluidExpansion`	A PoreFluidExpansion object.
`porousBulkModuli`	A PorousBulkModuli object.
`porousElastic`	A PorousElastic object.
`porousMetalPlasticity`	A PorousMetalPlasticity object.
`regularization`	A Regularization object.
`solubility`	A Solubility object.
`sorption`	A Sorption object.
`specificHeat`	A SpecificHeat object.
`swelling`	A Swelling object.
`userDefinedField`	A UserDefinedField object.
`userMaterial`	A UserMaterial object.
`userOutputVariables`	A UserOutputVariables object.
`viscoelastic`	A Viscoelastic object.
`viscosity`	A Viscosity object.
`viscous`	A Viscous object.

Public Methods:

`AcousticMedium`([acousticVolumetricDrag, ...])	This method creates an AcousticMedium object.
`BrittleCracking`(table[, ...])	This method creates a BrittleCracking object.
`CapPlasticity`(table[, ...])	This method creates a CapPlasticity object.
`CastIronPlasticity`(table[, ...])	This method creates a CastIronPlasticity object.
`ClayPlasticity`(table[, intercept, ...])	This method creates a ClayPlasticity object.
`Concrete`(table[, temperatureDependency, ...])	This method creates a Concrete object.
`ConcreteDamagedPlasticity`(table[, ...])	This method creates a ConcreteDamagedPlasticity object.
`Conductivity`(table[, type, ...])	This method creates a Conductivity object.
`Creep`(table[, law, temperatureDependency, ...])	This method creates a Creep object.
`CrushableFoam`(table[, hardening, ...])	This method creates a CrushableFoam object.
`Damping`([alpha, beta, composite, structural])	This method creates a Damping object.
`DeformationPlasticity`(table[, ...])	This method creates a DeformationPlasticity object.
`Density`(table[, temperatureDependency, ...])	This method creates a Density object.
`Depvar`([deleteVar, n])	This method creates a Depvar object.
`Dielectric`(table[, type, ...])	This method creates a Dielectric object.
`Diffusivity`(table[, type, law, ...])	This method creates a Diffusivity object.
`DruckerPrager`(table[, shearCriterion, ...])	This method creates a DruckerPrager object.
`Elastic`(table[, type, noCompression, ...])	This method creates an Elastic object.
`ElectricalConductivity`(table[, type, ...])	This method creates an ElectricalConductivity object.
`Eos`([type, temperatureDependency, ...])	This method creates an Eos object.
`Expansion`([type, userSubroutine, zero, ...])	This method creates an Expansion object.
`FluidLeakoff`([temperatureDependency, ...])	This method creates a FluidLeakoff object.
`GapFlow`(table[, kmax, ...])	This method creates a GapFlow object.
`GasketMembraneElastic`(table[, ...])	This method creates a GasketMembraneElastic object.
`GasketThicknessBehavior`(table[, ...])	This method creates a GasketThicknessBehavior object.
`GasketTransverseShearElastic`(table[, ...])	This method creates a GasketTransverseShearElastic object.
`Gel`(table)	This method creates a Gel object.
`Hyperelastic`(table[, type, moduliTimeScale, ...])	This method creates a Hyperelastic object.
`Hyperfoam`([testData, poisson, n, ...])	This method creates a Hyperfoam object.
`Hypoelastic`(table[, user])	This method creates a Hypoelastic object.
`InelasticHeatFraction`([fraction])	This method creates an InelasticHeatFraction object.
`JouleHeatFraction`([fraction])	This method creates a JouleHeatFraction object.
`LatentHeat`(table)	This method creates a LatentHeat object.
`LowDensityFoam`([elementRemoval, ...])	This method creates a LowDensityFoam object.
`MagneticPermeability`(table, table2, table3)	This method creates a MagneticPermeability object.
`MohrCoulombPlasticity`(table[, ...])	This method creates a MohrCoulombPlasticity object.
`MoistureSwelling`(table)	This method creates a MoistureSwelling object.
`Permeability`(specificWeight, ...[, type, ...])	This method creates a Permeability object.
`Piezoelectric`(table[, type, ...])	This method creates a Piezoelectric object.
`Plastic`(table[, hardening, rate, dataType, ...])	This method creates a Plastic object.
`PoreFluidExpansion`(table[, zero, ...])	This method creates a PoreFluidExpansion object.
`PorousBulkModuli`(table[, temperatureDependency])	This method creates a PorousBulkModuli object.
`PorousElastic`(table[, shear, ...])	This method creates a PorousElastic object.
`PorousMetalPlasticity`(table[, ...])	This method creates a PorousMetalPlasticity object.
`Regularization`([rtol, strainRateRegularization])	This method creates a Regularization object.
`Solubility`(table[, temperatureDependency, ...])	This method creates a Solubility object.
`Sorption`(absorptionTable[, lawAbsorption, ...])	This method creates a Sorption object.
`SpecificHeat`(table[, law, ...])	This method creates a SpecificHeat object.
`Swelling`(table[, law, ...])	This method creates a Swelling object.
`UserMaterial`([type, unsymm, ...])	This method creates a UserMaterial object.
`UserOutputVariables`([n])	This method creates a UserOutputVariables object.
`Viscoelastic`(domain, table[, frequency, ...])	This method creates a Viscoelastic object.
`Viscosity`(table[, type, ...])	This method creates a Viscosity object.
`Viscous`(table[, law, temperatureDependency, ...])	This method creates a Viscous object.
`DuctileDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`FldDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`FlsdDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`JohnsonCookDamageInitiation`(table[, ...])	This method creates A DamageInitiation object.
`MaxeDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`MaxsDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`MkDamageInitiation`(table[, definition, feq, ...])	This method creates A DamageInitiation object.
`MsfldDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`QuadeDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`QuadsDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`MaxpeDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`MaxpsDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`ShearDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.
`HashinDamageInitiation`(table[, definition, ...])	This method creates A DamageInitiation object.

Inherited from MaterialBase

`__init__`(name[, description, materialIdentifier])	This method creates a Material object.
`materialsFromOdb`(fileName)	This methods creates Material objects by reading an output database.

Member Details:

AcousticMedium( acousticVolumetricDrag=0, temperatureDependencyB=0, temperatureDependencyV=0, dependenciesB=0, dependenciesV=0, bulkTable=(), volumetricTable=(), )[源代码]¶

This method creates an AcousticMedium object.

备注

This function can be accessed by:

mdb.models[name].materials[name].AcousticMedium
session.odbs[name].materials[name].AcousticMedium

备注

Check AcousticMedium on help.3ds.com/2017.

参数:¶

acousticVolumetricDrag=0¶

A Boolean specifying whether the volumetricTable data is specified. The default value is OFF.

temperatureDependencyB=0¶

A Boolean specifying whether the data in bulkTable depend on temperature. The default value is OFF.

temperatureDependencyV=0¶

A Boolean specifying whether the data in volumetricTable depend on temperature. The default value is OFF.

dependenciesB=0¶

An Int specifying the number of field variable dependencies for the data in bulkTable. The default value is 0.

dependenciesV=0¶

An Int specifying the number of field variable dependencies for the data in volumetricTable. The default value is 0.

bulkTable=()¶

A sequence of sequences of Floats specifying the following:

Bulk modulus.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

volumetricTable=()¶

A sequence of sequences of Floats specifying the following:

Volumetric drag.
Frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The default value is an empty sequence.

返回:¶

An AcousticMedium object.

返回类型:¶

AcousticMedium

抛出:¶

RangeError --

BrittleCracking(table, temperatureDependency=0, dependencies=0, type=STRAIN)[源代码]¶

This method creates a BrittleCracking object.

备注

This function can be accessed by:

mdb.models[name].materials[name].BrittleCracking
session.odbs[name].materials[name].BrittleCracking

备注

Check BrittleCracking on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
type=STRAIN¶: A SymbolicConstant specifying the type of postcracking behavior. Possible values are STRAIN, DISPLACEMENT, and GFI. The default value is STRAIN.

返回:¶

A BrittleCracking object.

返回类型:¶

BrittleCracking

CapPlasticity(table, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a CapPlasticity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].CapPlasticity
session.odbs[name].materials[name].CapPlasticity

备注

Check CapPlasticity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A CapPlasticity object.

返回类型:¶

CapPlasticity

抛出:¶

RangeError --

CastIronPlasticity(table, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a CastIronPlasticity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].CastIronPlasticity
session.odbs[name].materials[name].CastIronPlasticity

备注

Check CastIronPlasticity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A CastIronPlasticity object.

返回类型:¶

CastIronPlasticity

抛出:¶

RangeError --

ClayPlasticity( table, intercept=None, hardening=EXPONENTIAL, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a ClayPlasticity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].ClayPlasticity
session.odbs[name].materials[name].ClayPlasticity

备注

Check ClayPlasticity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
intercept=None¶: None or a Float specifying \(e_1\), the intercept of the virgin consolidation line with the void ratio axis in a plot of void ratio versus the logarithm of pressure stress. The default value is None.This argument is valid only if hardening = EXPONENTIAL.
hardening=EXPONENTIAL¶: A SymbolicConstant specifying the type of hardening/softening definition. Possible values are EXPONENTIAL and TABULAR. The default value is EXPONENTIAL.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A ClayPlasticity object.

返回类型:¶

ClayPlasticity

抛出:¶

RangeError --

Concrete(table, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a Concrete object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Concrete
session.odbs[name].materials[name].Concrete

备注

Check Concrete on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Concrete object.

返回类型:¶

Concrete

抛出:¶

RangeError --

ConcreteDamagedPlasticity(table, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a ConcreteDamagedPlasticity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].ConcreteDamagedPlasticity
session.odbs[name].materials[name].ConcreteDamagedPlasticity

备注

Check ConcreteDamagedPlasticity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A ConcreteDamagedPlasticity object.

返回类型:¶

ConcreteDamagedPlasticity

抛出:¶

RangeError --

Conductivity(table, type=ISOTROPIC, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a Conductivity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Conductivity
session.odbs[name].materials[name].Conductivity

备注

Check Conductivity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
type=ISOTROPIC¶: A SymbolicConstant specifying the type of conductivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Conductivity object.

返回类型:¶

Conductivity

抛出:¶

RangeError --

Creep(table, law=STRAIN, temperatureDependency=0, dependencies=0, time=TOTAL)[源代码]¶

This method creates a Creep object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Creep
session.odbs[name].materials[name].Creep

备注

Check Creep on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
law=STRAIN¶: A SymbolicConstant specifying the strain-hardening law. Possible values are STRAIN, TIME, HYPERBOLIC_SINE and USER. The default value is STRAIN.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
time=TOTAL¶: A SymbolicConstant specifying the time interval for relevant laws. Possible values are CREEP and TOTAL. The default value is TOTAL.

返回:¶

A Creep object.

返回类型:¶

Creep

抛出:¶

RangeError --

CrushableFoam( table, hardening=VOLUMETRIC, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a CrushableFoam object.

备注

This function can be accessed by:

mdb.models[name].materials[name].CrushableFoam
session.odbs[name].materials[name].CrushableFoam

备注

Check CrushableFoam on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
hardening=VOLUMETRIC¶: A SymbolicConstant specifying the type of hardening/softening definition. Possible values are VOLUMETRIC and ISOTROPIC. The default value is VOLUMETRIC.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A CrushableFoam object.

返回类型:¶

CrushableFoam

抛出:¶

RangeError --

Damping(alpha=0, beta=0, composite=0, structural=0)[源代码]¶

This method creates a Damping object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Damping
session.odbs[name].materials[name].Damping

参数:¶

alpha=0¶: A Float specifying the αRαR factor to create mass proportional damping in direct-integration and explicit dynamics. The default value is 0.0.
beta=0¶: A Float specifying the βRβR factor to create stiffness proportional damping in direct-integration and explicit dynamics. The default value is 0.0.
composite=0¶: A Float specifying the fraction of critical damping to be used with this material in calculating composite damping factors for the modes (for use in modal dynamics). The default value is 0.0.This argument applies only to Abaqus/Standard analyses.
structural=0¶: A Float specifying the structural factor to create material damping in direct-integration and explicit dynamics. The default value is 0.0.

返回:¶

A Damping object.

返回类型:¶

Damping

抛出:¶

RangeError --

DeformationPlasticity(table, temperatureDependency=0)[源代码]¶

This method creates a DeformationPlasticity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].DeformationPlasticity
session.odbs[name].materials[name].DeformationPlasticity

备注

Check DeformationPlasticity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.

返回:¶

A DeformationPlasticity object.

返回类型:¶

DeformationPlasticity

抛出:¶

RangeError --

Density( table, temperatureDependency=0, dependencies=0, distributionType=UNIFORM, fieldName='', )[源代码]¶

This method creates a Density object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Density
session.odbs[name].materials[name].Density

备注

Check Density on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
distributionType=UNIFORM¶: A SymbolicConstant specifying how the density is distributed spatially. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.
fieldName=''¶: A String specifying the name of the AnalyticalField or DiscreteField object associated with this material option. The fieldName argument applies only when distributionType = ANALYTICAL_FIELD or distributionType = DISCRETE_FIELD. The default value is an empty string.

返回:¶

A Density object.

返回类型:¶

Density

抛出:¶

RangeError --

Depvar(deleteVar=0, n=0)[源代码]¶

This method creates a Depvar object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Depvar
session.odbs[name].materials[name].Depvar

备注

Check Depvar on help.3ds.com/2017.

参数:¶

deleteVar=0¶: An Int specifying the state variable number controlling the element deletion flag. The default value is 0.This argument applies only to Abaqus/Explicit analyses.
n=0¶: An Int specifying the number of solution-dependent state variables required at each integration point. The default value is 0.

返回:¶

A Depvar object.

返回类型:¶

Depvar

抛出:¶

RangeError --

Dielectric( table, type=ISOTROPIC, frequencyDependency=0, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a Dielectric object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Dielectric
session.odbs[name].materials[name].Dielectric

备注

Check Dielectric on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
type=ISOTROPIC¶: A SymbolicConstant specifying the dielectric behavior. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.
frequencyDependency=0¶: A Boolean specifying whether the data depend on frequency. The default value is OFF.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Dielectric object.

返回类型:¶

Dielectric

Diffusivity( table, type=ISOTROPIC, law=GENERAL, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a Diffusivity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Diffusivity
session.odbs[name].materials[name].Diffusivity

备注

Check Diffusivity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
type=ISOTROPIC¶: A SymbolicConstant specifying the type of diffusivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.
law=GENERAL¶: A SymbolicConstant specifying the diffusion behavior. Possible values are GENERAL and FICK. The default value is GENERAL.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Diffusivity object.

返回类型:¶

Diffusivity

抛出:¶

RangeError --

DruckerPrager( table, shearCriterion=LINEAR, eccentricity=0, testData=0, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a DruckerPrager object.

备注

This function can be accessed by:

mdb.models[name].materials[name].DruckerPrager
session.odbs[name].materials[name].DruckerPrager

备注

Check DruckerPrager on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
shearCriterion=LINEAR¶: A SymbolicConstant specifying the yield criterion. Possible values are LINEAR, HYPERBOLIC, and EXPONENTIAL. The default value is LINEAR.This argument applies only to Abaqus/Standard analyses. Only the linear Drucker-Prager model is available in Abaqus/Explicit analyses.
eccentricity=0¶: A Float specifying the flow potential eccentricity, \(\epsilon\), a small positive number that defines the rate at which the hyperbolic flow potential approaches its asymptote. The default value is 0.1.This argument applies only to Abaqus/Standard analyses.
testData=0¶: A Boolean specifying whether the material constants for the exponent model are to be computed by Abaqus/Standard from triaxial test data at different levels of confining pressure. The default value is OFF.This argument is valid only if shearCriterion = EXPONENTIAL.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A DruckerPrager object.

返回类型:¶

DruckerPrager

抛出:¶

RangeError --

DuctileDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].DuctileDamageInitiation
session.odbs[name].materials[name].DuctileDamageInitiation

备注

Check DuctileDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

Elastic( table, type=ISOTROPIC, noCompression=0, noTension=0, temperatureDependency=0, dependencies=0, moduli=LONG_TERM, )[源代码]¶

This method creates an Elastic object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Elastic
session.odbs[name].materials[name].Elastic

备注

Check Elastic on help.3ds.com/2017.

参数:¶

table¶

A sequence of sequences of Floats specifying the items described below.

type=ISOTROPIC¶

A SymbolicConstant specifying the type of elasticity data provided. Possible values are:

ISOTROPIC
ORTHOTROPIC
ANISOTROPIC
ENGINEERING_CONSTANTS
LAMINA
TRACTION
COUPLED_TRACTION
SHORT_FIBER
SHEAR

The default value is ISOTROPIC.

noCompression=0¶

A Boolean specifying whether compressive stress is allowed. The default value is OFF.

noTension=0¶

A Boolean specifying whether tensile stress is allowed. The default value is OFF.

temperatureDependency=0¶

A Boolean specifying whether the data depend on temperature. The default value is OFF.

dependencies=0¶

An Int specifying the number of field variable dependencies. The default value is 0.

moduli=LONG_TERM¶

A SymbolicConstant specifying the time-dependence of the elastic material constants. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.

返回:¶

An Elastic object.

返回类型:¶

Elastic

抛出:¶

RangeError --

ElectricalConductivity( table, type=ISOTROPIC, frequencyDependency=0, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates an ElectricalConductivity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].ElectricalConductivity
session.odbs[name].materials[name].ElectricalConductivity

备注

Check ElectricalConductivity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
type=ISOTROPIC¶: A SymbolicConstant specifying the type of electrical conductivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.
frequencyDependency=0¶: A Boolean specifying whether the data depend on frequency. The default value is OFF.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

An ElectricalConductivity object.

返回类型:¶

ElectricalConductivity

抛出:¶

RangeError --

Eos( type=IDEALGAS, temperatureDependency=0, dependencies=0, detonationEnergy=0, solidTable=(), gasTable=(), reactionTable=(), gasSpecificTable=(), table=(), )[源代码]¶

This method creates an Eos object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Eos
session.odbs[name].materials[name].Eos

备注

Check Eos on help.3ds.com/2017.

参数:¶

type=IDEALGAS¶

A SymbolicConstant specifying the equation of state. Possible values are USUP, JWL, IDEALGAS, TABULAR, and IGNITIONANDGROWTH. The default value is IDEALGAS.

temperatureDependency=0¶

A Boolean specifying whether the data in gasSpecificTable depend on temperature. The default value is OFF.

dependencies=0¶

An Int specifying the number of field variable dependencies for the data in gasSpecificTable. The default value is 0.

detonationEnergy=0¶

A Float specifying the detonation energy text field. The default value is 0.0.

solidTable=()¶

A sequence of sequences of Floats specifying the following:

\(A_{s}\).
\(B_{s}\).
\({\omega}_{s}\).
\(R_{1s}\).
\(R_{2s}\).

The default value is an empty sequence.

gasTable=()¶

A sequence of sequences of Floats specifying the following:

\(A_{g}\).
\(B_{g}\).
\({\omega}_{g}\).
\(R_{1g}\).
\(R_{2g}\).

The default value is an empty sequence.

reactionTable=()¶

A sequence of sequences of Floats specifying the following:

Initial Pressure, \(I\).
Product co-volume, \(a\).
Exponent on the unreacted fraction (ignition term), \(x\).
First burn rate coefficient, \(G_{1}\)
Exponent on the unreacted fraction (growth term), \(c\).
Exponent on the reacted fraction (growth term), \(d\).
Pressure exponent (growth term), \(y\).
Second burn rate coefficient, \(G_{2}\).
Exponent on the unreacted fraction (completion term), \(e\).
Exponent on the reacted fraction (completion term), \(g\).
Pressure exponent (completion term), \(z\).
Initial reacted fraction, \({F^{max}}_{ig}\).
Maximum reacted fraction for the growth term, \({F^{max}}_{G1}\).
Minimum reacted fraction, \({F^{min}}_{G2}\).

The default value is an empty sequence.

gasSpecificTable=()¶

A sequence of sequences of Floats specifying the following:

Specific Heat per unit mass.
Temperature dependent data.
Value of first field variable.
Value of second field variable.
Etc.

The default value is an empty sequence.

table=()¶

A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.

Expansion( type=ISOTROPIC, userSubroutine=0, zero=0, temperatureDependency=0, dependencies=0, table=(), )[源代码]¶

This method creates an Expansion object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Expansion
session.odbs[name].materials[name].Expansion

备注

Check Expansion on help.3ds.com/2017.

参数:¶

type=ISOTROPIC¶: A SymbolicConstant specifying the type of expansion. Possible values are ISOTROPIC, ORTHOTROPIC, ANISOTROPIC, and SHORT_FIBER. The default value is ISOTROPIC.
userSubroutine=0¶: A Boolean specifying whether a user subroutine is used to define the increments of thermal strain. The default value is OFF.
zero=0¶: A Float specifying the value of :math:` heta_0` if the thermal expansion is temperature-dependent or field-variable-dependent. The default value is 0.0.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
table=()¶: A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.This argument is required only if type is not USER.

返回:¶

An Expansion object.

返回类型:¶

Expansion

抛出:¶

RangeError --

FldDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].FldDamageInitiation
session.odbs[name].materials[name].FldDamageInitiation

备注

Check FldDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

FlsdDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].FlsdDamageInitiation
session.odbs[name].materials[name].FlsdDamageInitiation

备注

Check FlsdDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

FluidLeakoff( temperatureDependency=0, dependencies=0, type=COEFFICIENTS, table=(), )[源代码]¶

This method creates a FluidLeakoff object.

备注

This function can be accessed by:

mdb.models[name].materials[name].FluidLeakoff
session.odbs[name].materials[name].FluidLeakoff

备注

Check FluidLeakoff on help.3ds.com/2017.

参数:¶

temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
type=COEFFICIENTS¶: A SymbolicConstant specifying the type of fluid leak-off. Possible values are COEFFICIENTS and USER. The default value is COEFFICIENTS.
table=()¶: A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.

返回:¶

A FluidLeakoff object.

返回类型:¶

FluidLeakoff

GapFlow( table, kmax=None, temperatureDependency=0, dependencies=0, type=NEWTONIAN, )[源代码]¶

This method creates a GapFlow object.

备注

This function can be accessed by:

mdb.models[name].materials[name].GapFlow
session.odbs[name].materials[name].GapFlow

备注

Check GapFlow on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
kmax=None¶: None or a Float specifying the maximum permeability value that should be used. If kmax = None, Abaqus assumes that the permeability is not bounded. This value is meaningful only when type = NEWTONIAN. The default value is None.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
type=NEWTONIAN¶: A SymbolicConstant specifying the type of gap flow. Possible values are NEWTONIAN, and POWER_LAW. The default value is NEWTONIAN.

返回:¶

A GapFlow object.

返回类型:¶

GapFlow

GasketMembraneElastic(table, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a GasketMembraneElastic object.

备注

This function can be accessed by:

mdb.models[name].materials[name].GasketMembraneElastic
session.odbs[name].materials[name].GasketMembraneElastic

备注

Check GasketMembraneElastic on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A GasketMembraneElastic object.

返回类型:¶

GasketMembraneElastic

抛出:¶

RangeError --

GasketThicknessBehavior( table, temperatureDependency=0, dependencies=0, tensileStiffnessFactor=None, type=ELASTIC_PLASTIC, unloadingDependencies=0, unloadingTemperatureDependency=0, variableUnits=STRESS, yieldOnset=0, yieldOnsetMethod=RELATIVE_SLOPE_DROP, unloadingTable=(), )[源代码]¶

This method creates a GasketThicknessBehavior object.

备注

This function can be accessed by:

mdb.models[name].materials[name].GasketThicknessBehavior
session.odbs[name].materials[name].GasketThicknessBehavior

备注

Check GasketThicknessBehavior on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying loading data. The first sequence must contain only 0. At least two sequences must be specified if type = DAMAGE, and at least 3 sequences must be specified if type = ELASTIC_PLASTIC. The items in the table data are described below.
temperatureDependency=0¶: A Boolean specifying whether the loading data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies included in the definition of the loading data, in addition to temperature. The default value is 0.
tensileStiffnessFactor=None¶: A Float specifying the fraction of the initial compressive stiffness that defines the stiffness in tension. The default value is 10⁻³.
type=ELASTIC_PLASTIC¶: A SymbolicConstant specifying a damage elasticity model or an elastic-Plastic model for gasket thickness-direction behavior. Possible values are ELASTIC_PLASTIC and DAMAGE. The default value is ELASTIC_PLASTIC.
unloadingDependencies=0¶: An Int specifying the number of field variable dependencies included in the definition of the unloading data, in addition to temperature. The default value is 0.
unloadingTemperatureDependency=0¶: A Boolean specifying whether unloading data depends on temperature. The default value is OFF.
variableUnits=STRESS¶: A SymbolicConstant specifying the behavior in terms of units of force (or force in unit length) versus closure or pressure versus closure. Possible values are STRESS and FORCE. The default value is STRESS.
yieldOnset=0¶: A Float specifying the closure value at which the onset of yield occurs or the relative drop in slope on the loading curve that defines the onset of Plastic deformation (depending on the value of yieldOnsetMethod). The default value is 0.1.
yieldOnsetMethod=RELATIVE_SLOPE_DROP¶: A SymbolicConstant specifying the method used to determine yield onset. Possible values are RELATIVE_SLOPE_DROP and CLOSURE_VALUE. The default value is RELATIVE_SLOPE_DROP.
unloadingTable=()¶: A sequence of sequences of Floats specifying unloading data. The items in the table data are described below. The default value is an empty sequence.

返回:¶

A GasketThicknessBehavior object.

返回类型:¶

GasketThicknessBehavior

抛出:¶

RangeError --

GasketTransverseShearElastic( table, variableUnits=STRESS, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a GasketTransverseShearElastic object.

备注

This function can be accessed by:

mdb.models[name].materials[name].GasketTransverseShearElastic
session.odbs[name].materials[name].GasketTransverseShearElastic

备注

Check GasketTransverseShearElastic on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
variableUnits=STRESS¶: A SymbolicConstant specifying the unit system in which the transverse shear behavior will be defined. Possible values are STRESS and FORCE. The default value is STRESS.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A GasketTransverseShearElastic object.

返回类型:¶

GasketTransverseShearElastic

抛出:¶

RangeError --

Gel(table)[源代码]¶

This method creates a Gel object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Gel
session.odbs[name].materials[name].Gel

备注

Check Gel on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.

返回:¶

A Gel object.

返回类型:¶

Gel

HashinDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].HashinDamageInitiation
session.odbs[name].materials[name].HashinDamageInitiation

备注

Check HashinDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

Hyperelastic( table, type=UNKNOWN, moduliTimeScale=LONG_TERM, temperatureDependency=0, n=1, beta=FITTED_VALUE, testData=1, compressible=0, properties=0, deviatoricResponse=UNIAXIAL, volumetricResponse=DEFAULT, poissonRatio=0, materialType=ISOTROPIC, anisotropicType=FUNG_ANISOTROPIC, formulation=STRAIN, behaviorType=INCOMPRESSIBLE, dependencies=0, localDirections=0, )[源代码]¶

This method creates a Hyperelastic object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Hyperelastic
session.odbs[name].materials[name].Hyperelastic

备注

Check Hyperelastic on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below. This argument is valid only if testData = OFF.
type=UNKNOWN¶: A SymbolicConstant specifying the type of strain energy potential. Possible values are:ARRUDA_BOYCEMARLOWMOONEY_RIVLINNEO_HOOKEOGDENPOLYNOMIALREDUCED_POLYNOMIALUSERVAN_DER_WAALSYEOHUNKNOWNThe default value is UNKNOWN.
moduliTimeScale=LONG_TERM¶: A SymbolicConstant specifying the nature of the time response. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
n=1¶: An Int specifying the order of the strain energy potential. The default value is 1.If testData = ON and type = POLYNOMIAL, n can take only the values 1 or 2.If testData = ON and type = OGDEN or if testData = OFF for either type, 1 ≤n≤n≤ 6.If type = USER, this argument cannot be used.
beta=FITTED_VALUE¶: The SymbolicConstant FITTED_VALUE or a Float specifying the invariant mixture parameter. This argument is valid only if testData = ON and type = VAN_DER_WAALS. The default value is FITTED_VALUE.
testData=1¶: A Boolean specifying whether test data are supplied. The default value is ON.
compressible=0¶: A Boolean specifying whether the hyperelastic material is compressible. This parameter is applicable only to user-defined hyperelastic materials. The default value is OFF.
properties=0¶: An Int specifying the number of property values needed as data for the user-defined hyperelastic material. The default value is 0.
deviatoricResponse=UNIAXIAL¶: A SymbolicConstant specifying which test data to use. Possible values are UNIAXIAL, BIAXIAL, and PLANAR. The default value is UNIAXIAL.
volumetricResponse=DEFAULT¶: A SymbolicConstant specifying the volumetric response. Possible values are DEFAULT, VOLUMETRIC_DATA, POISSON_RATIO, and LATERAL_NOMINAL_STRAIN. The default value is DEFAULT.
poissonRatio=0¶: A Float specifying the poisson ratio. This argument is valid only if volumetricResponse = POISSON_RATIO. The default value is 0.0.
materialType=ISOTROPIC¶: A SymbolicConstant specifying the type of material. Possible values are ISOTROPIC and ANISOTROPIC. The default value is ISOTROPIC.
anisotropicType=FUNG_ANISOTROPIC¶: A SymbolicConstant specifying the type of strain energy potential. Possible values are FUNG_ANISOTROPIC, FUNG_ORTHOTROPIC, HOLZAPFEL, and USER_DEFINED. The default value is FUNG_ANISOTROPIC.
formulation=STRAIN¶: A SymbolicConstant specifying the type of formulation. Possible values are STRAIN and INVARIANT. The default value is STRAIN.
behaviorType=INCOMPRESSIBLE¶: A SymbolicConstant specifying the type of anisotropic hyperelastic material behavior. Possible values are INCOMPRESSIBLE and COMPRESSIBLE. The default value is INCOMPRESSIBLE.
dependencies=0¶: An Int specifying the number of field variable dependencies for the data in*volumetricTable* . The default value is 0.
localDirections=0¶: An Int specifying the number of local directions for the data in*volumetricTable* . The default value is 0.

返回:¶

A Hyperelastic object.

返回类型:¶

Hyperelastic

抛出:¶

InvalidNameError --
RangeError --

Hyperfoam( testData=0, poisson=None, n=1, temperatureDependency=0, moduli=LONG_TERM, table=(), )[源代码]¶

This method creates a Hyperfoam object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Hyperfoam
session.odbs[name].materials[name].Hyperfoam

备注

Check Hyperfoam on help.3ds.com/2017.

参数:¶

testData=0¶: A Boolean specifying whether test data are supplied. The default value is OFF.
poisson=None¶: None or a Float specifying the effective Poisson's ratio, νν, of the material. This argument is valid only when testData = ON. The default value is None.
n=1¶: An Int specifying the order of the strain energy potential. Possible values are 1 ≤n≤n≤ 6. The default value is 1.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
moduli=LONG_TERM¶: A SymbolicConstant specifying the time-dependence of the material constants. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.
table=()¶: A sequence of sequences of Floats specifying the items described below. This argument is valid only when testData = OFF. The default value is an empty sequence.

返回:¶

A Hyperfoam object.

返回类型:¶

Hyperfoam

抛出:¶

RangeError --

Hypoelastic(table, user=0)[源代码]¶

This method creates a Hypoelastic object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Hypoelastic
session.odbs[name].materials[name].Hypoelastic

备注

Check Hypoelastic on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
user=0¶: A Boolean specifying that hypoelasticity is defined by user subroutine UHYPEL. The default value is OFF.

返回:¶

A Hypoelastic object.

返回类型:¶

Hypoelastic

InelasticHeatFraction(fraction=0)[源代码]¶

This method creates an InelasticHeatFraction object.

备注

This function can be accessed by:

mdb.models[name].materials[name].InelasticHeatFraction
session.odbs[name].materials[name].InelasticHeatFraction

备注

Check InelasticHeatFraction on help.3ds.com/2017.

参数:¶

fraction=0¶: A Float specifying the fraction of inelastic dissipation rate that appears as a heat flux per unit volume. The fraction may include a unit conversion factor if required. Possible values are 0.0 ≤ fraction ≤ 1.0. The default value is 0.9.

返回:¶

An InelasticHeatFraction object.

返回类型:¶

InelasticHeatFraction

抛出:¶

RangeError --

JohnsonCookDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].JohnsonCookDamageInitiation
session.odbs[name].materials[name].JohnsonCookDamageInitiation

备注

Check JohnsonCookDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

JouleHeatFraction(fraction=1)[源代码]¶

This method creates a JouleHeatFraction object.

备注

This function can be accessed by:

mdb.models[name].materials[name].JouleHeatFraction
session.odbs[name].materials[name].JouleHeatFraction

备注

Check JouleHeatFraction on help.3ds.com/2017.

参数:¶

fraction=1¶: A Float specifying the fraction of electrical energy released as heat, including any unit conversion factor. The default value is 1.0.

返回:¶

A JouleHeatFraction object.

返回类型:¶

JouleHeatFraction

抛出:¶

RangeError --

LatentHeat(table)[源代码]¶

This method creates a LatentHeat object.

备注

This function can be accessed by:

mdb.models[name].materials[name].LatentHeat
session.odbs[name].materials[name].LatentHeat

备注

Check LatentHeat on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.

返回:¶

A LatentHeat object.

返回类型:¶

LatentHeat

抛出:¶

RangeError --

LowDensityFoam( elementRemoval=0, maxAllowablePrincipalStress=None, extrapolateStressStrainCurve=0, strainRateType=VOLUMETRIC, mu0=None, mu1=0, alpha=2, )[源代码]¶

This method creates a LowDensityFoam object.

备注

This function can be accessed by:

mdb.models[name].materials[name].LowDensityFoam
session.odbs[name].materials[name].LowDensityFoam

备注

Check LowDensityFoam on help.3ds.com/2017.

参数:¶

elementRemoval=0¶: A Boolean specifying whether elements are removed if exceeding maximum principal tensile stress. This argument is valid only when maxAllowablePrincipalStress is defined. The default value is OFF.
maxAllowablePrincipalStress=None¶: None or a Float specifying the maximum allowable principal tensile stress. The default value is None.
extrapolateStressStrainCurve=0¶: A Boolean specifying whether the stress-strain curve is extrapolated if exceeding maximum strain rate. The default value is OFF.
strainRateType=VOLUMETRIC¶: A SymbolicConstant specifying strain rate measure used for constitutive calculations. Possible values are PRINCIPAL and VOLUMETRIC. The default value is VOLUMETRIC.
mu0=None¶: A Float specifying the relaxation coefficient μ0. The default value is 10⁻⁴.
mu1=0¶: A Float specifying the relaxation coefficient μ1. The default value is 0.5x10⁻².
alpha=2¶: A Float specifying the relaxation coefficient α. The default value is 2.0.

返回:¶

A LowDensityFoam object.

返回类型:¶

LowDensityFoam

抛出:¶

RangeError --

MagneticPermeability( table, table2, table3, type=ISOTROPIC, frequencyDependency=0, temperatureDependency=0, dependencies=0, nonlinearBH=0, )[源代码]¶

This method creates a MagneticPermeability object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MagneticPermeability
session.odbs[name].materials[name].MagneticPermeability

备注

Check MagneticPermeability on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below in “Table data.” If type = ORTHOTROPIC and nonlinearBH=ON, the data specified in the table is for the first direction and table2 and table3 must be specified.
table2¶: A sequence of sequences of Floats specifying the items described below in “Table data” in the second direction. table2 must be specified only if type = ORTHOTROPIC and nonlinearBH=ON.
table3¶: A sequence of sequences of Floats specifying the items described below in “Table data” in the third direction. table3 must be specified only if type = ORTHOTROPIC and nonlinearBH=ON.
type=ISOTROPIC¶: A SymbolicConstant specifying the type of magnetic permeability. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.
frequencyDependency=0¶: A Boolean specifying whether the data depend on frequency. The default value is OFF.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
nonlinearBH=0¶: A Boolean specifying whether the magnetic behavior is nonlinear and available in tabular form of magnetic flux density versus magnetic field values. The default value is OFF.

返回:¶

A MagneticPermeability object.

返回类型:¶

MagneticPermeability

抛出:¶

RangeError --

MaxeDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, position=CENTROID, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MaxeDamageInitiation
session.odbs[name].materials[name].MaxeDamageInitiation

备注

Check MaxeDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

MaxpeDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, position=CENTROID, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MaxpeDamageInitiation
session.odbs[name].materials[name].MaxpeDamageInitiation

备注

Check MaxpeDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

MaxpsDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, position=CENTROID, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MaxpsDamageInitiation
session.odbs[name].materials[name].MaxpsDamageInitiation

备注

Check MaxpsDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

MaxsDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, position=CENTROID, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MaxsDamageInitiation
session.odbs[name].materials[name].MaxsDamageInitiation

备注

Check MaxsDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

MkDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MkDamageInitiation
session.odbs[name].materials[name].MkDamageInitiation

备注

Check MkDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

MohrCoulombPlasticity( table, deviatoricEccentricity=None, meridionalEccentricity=0, temperatureDependency=0, dependencies=0, useTensionCutoff=0, )[源代码]¶

This method creates a MohrCoulombPlasticity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MohrCoulombPlasticity
session.odbs[name].materials[name].MohrCoulombPlasticity

备注

Check MohrCoulombPlasticity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
deviatoricEccentricity=None¶: None or a Float specifying the flow potential eccentricity in the deviatoric plane, \(e\); \(1 / 2 \leq e \leq 1.0\). If deviatoricEccentricity = None, Abaqus calculates the value using the specified Mohr-Coulomb angle of friction. The default value is None.
meridionalEccentricity=0¶: A Float specifying the flow potential eccentricity in the meridional plane, ϵϵ. The default value is 0.1.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
useTensionCutoff=0¶: A Boolean specifying whether tension cutoff specification is needed. The default value is OFF.

返回:¶

A MohrCoulombPlasticity object.

返回类型:¶

MohrCoulombPlasticity

抛出:¶

RangeError --

MoistureSwelling(table)[源代码]¶

This method creates a MoistureSwelling object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MoistureSwelling
session.odbs[name].materials[name].MoistureSwelling

备注

Check MoistureSwelling on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.

返回:¶

A MoistureSwelling object.

返回类型:¶

MoistureSwelling

MsfldDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MsfldDamageInitiation
session.odbs[name].materials[name].MsfldDamageInitiation

备注

Check MsfldDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

Permeability( specificWeight, inertialDragCoefficient, table, type=ISOTROPIC, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a Permeability object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Permeability
session.odbs[name].materials[name].Permeability

备注

Check Permeability on help.3ds.com/2017.

参数:¶

specificWeight¶: A Float specifying the specific weight of the wetting liquid, \(\gamma_w\).
inertialDragCoefficient¶: A Float specifying The inertial drag coefficient of the wetting liquid, \(\gamma_w\).
table¶: A sequence of sequences of Floats specifying the items described below.
type=ISOTROPIC¶: A SymbolicConstant specifying the type of permeability. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Permeability object.

返回类型:¶

Permeability

抛出:¶

RangeError --

Piezoelectric(table, type=STRESS, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a Piezoelectric object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Piezoelectric
session.odbs[name].materials[name].Piezoelectric

备注

Check Piezoelectric on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
type=STRESS¶: A SymbolicConstant specifying the type of material coefficients for the piezoelectric property. Possible values are STRAIN and STRESS. The default value is STRESS.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Piezoelectric object.

返回类型:¶

Piezoelectric

Plastic( table, hardening=ISOTROPIC, rate=0, dataType=HALF_CYCLE, strainRangeDependency=0, numBackstresses=1, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a Plastic object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Plastic
session.odbs[name].materials[name].Plastic

备注

Check Plastic on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
hardening=ISOTROPIC¶: A SymbolicConstant specifying the type of hardening. Possible values are ISOTROPIC, KINEMATIC, COMBINED, JOHNSON_COOK, and USER. The default value is ISOTROPIC.
rate=0¶: A Boolean specifying whether the data depend on rate. The default value is OFF.
dataType=HALF_CYCLE¶: A SymbolicConstant specifying the type of combined hardening. This argument is only valid if hardening = COMBINED. Possible values are HALF_CYCLE, PARAMETERS, and STABILIZED. The default value is HALF_CYCLE.
strainRangeDependency=0¶: A Boolean specifying whether the data depend on strain range. This argument is only valid if hardening = COMBINED and dataType = STABILIZED. The default value is OFF.
numBackstresses=1¶: An Int specifying the number of backstresses. This argument is only valid if hardening = COMBINED. The default value is 1.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Plastic object.

返回类型:¶

Plastic

抛出:¶

RangeError --

PoreFluidExpansion(table, zero=0, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a PoreFluidExpansion object.

备注

This function can be accessed by:

mdb.models[name].materials[name].PoreFluidExpansion
session.odbs[name].materials[name].PoreFluidExpansion

备注

Check PoreFluidExpansion on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
zero=0¶: A Float specifying the value of θ0. The default value is 0.0.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A PoreFluidExpansion object.

返回类型:¶

PoreFluidExpansion

抛出:¶

RangeError --

PorousBulkModuli(table, temperatureDependency=0)[源代码]¶

This method creates a PorousBulkModuli object.

备注

This function can be accessed by:

mdb.models[name].materials[name].PorousBulkModuli
session.odbs[name].materials[name].PorousBulkModuli

备注

Check PorousBulkModuli on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.

返回:¶

A PorousBulkModuli object.

返回类型:¶

PorousBulkModuli

PorousElastic(table, shear=POISSON, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a PorousElastic object.

备注

This function can be accessed by:

mdb.models[name].materials[name].PorousElastic
session.odbs[name].materials[name].PorousElastic

备注

Check PorousElastic on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
shear=POISSON¶: A SymbolicConstant specifying the shear definition form. Possible values are G and POISSON. The default value is POISSON.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A PorousElastic object.

返回类型:¶

PorousElastic

抛出:¶

RangeError --

PorousMetalPlasticity( table, relativeDensity=None, temperatureDependency=0, dependencies=0, )[源代码]¶

This method creates a PorousMetalPlasticity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].PorousMetalPlasticity
session.odbs[name].materials[name].PorousMetalPlasticity

备注

Check PorousMetalPlasticity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
relativeDensity=None¶: None or a Float specifying the initial relative density of the material, r0. The default value is None.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A PorousMetalPlasticity object.

返回类型:¶

PorousMetalPlasticity

抛出:¶

RangeError --

QuadeDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, position=CENTROID, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].QuadeDamageInitiation
session.odbs[name].materials[name].QuadeDamageInitiation

备注

Check QuadeDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

QuadsDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, position=CENTROID, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].QuadsDamageInitiation
session.odbs[name].materials[name].QuadsDamageInitiation

备注

Check QuadsDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

Regularization(rtol=0, strainRateRegularization=LOGARITHMIC)[源代码]¶

This method creates a Regularization object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Regularization
session.odbs[name].materials[name].Regularization

备注

Check Regularization on help.3ds.com/2017.

参数:¶

rtol=0¶: A Float specifying the tolerance to be used for regularizing material data. The default value is 0.03.
strainRateRegularization=LOGARITHMIC¶: A SymbolicConstant specifying the form of regularization of strain-rate-dependent material data. Possible values are LOGARITHMIC and LINEAR. The default value is LOGARITHMIC.

返回:¶

A Regularization object.

返回类型:¶

Regularization

抛出:¶

RangeError --

ShearDamageInitiation( table, definition=MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=0, dependencies=0, alpha=0, omega=1, tolerance=0, direction=NMORI, )[源代码]¶

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].ShearDamageInitiation
session.odbs[name].materials[name].ShearDamageInitiation

备注

Check ShearDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

Solubility(table, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a Solubility object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Solubility
session.odbs[name].materials[name].Solubility

备注

Check Solubility on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Solubility object.

返回类型:¶

Solubility

抛出:¶

RangeError --

Sorption( absorptionTable, lawAbsorption=TABULAR, exsorption=0, lawExsorption=TABULAR, scanning=0, exsorptionTable=(), )[源代码]¶

This method creates a Sorption object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Sorption
session.odbs[name].materials[name].Sorption

备注

Check Sorption on help.3ds.com/2017.

参数:¶

absorptionTable¶: A sequence of sequences of Floats specifying the items described below.
lawAbsorption=TABULAR¶: A SymbolicConstant specifying absorption behavior. Possible values are LOG and TABULAR. The default value is TABULAR.
exsorption=0¶: A Boolean specifying whether the exsorption data is specified. The default value is OFF.
lawExsorption=TABULAR¶: A SymbolicConstant specifying exsorption behavior. Possible values are LOG and TABULAR. The default value is TABULAR.
scanning=0¶: A Float specifying the slope of the scanning line, \(\left.\left(d u_{w} / d s\right)\right|_{s}\). This slope must be positive and larger than the slope of the absorption or exsorption behaviors. The default value is 0.0.
exsorptionTable=()¶: A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.

返回:¶

A Sorption object.

返回类型:¶

Sorption

抛出:¶

RangeError --

SpecificHeat(table, law=CONSTANTVOLUME, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a SpecificHeat object.

备注

This function can be accessed by:

mdb.models[name].materials[name].SpecificHeat
session.odbs[name].materials[name].SpecificHeat

备注

Check SpecificHeat on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
law=CONSTANTVOLUME¶: A SymbolicConstant specifying the specific heat behavior. Possible values are CONSTANTVOLUME and CONSTANTPRESSURE. The default value is CONSTANTVOLUME.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A SpecificHeat object.

返回类型:¶

SpecificHeat

抛出:¶

RangeError --

Swelling(table, law=INPUT, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a Swelling object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Swelling
session.odbs[name].materials[name].Swelling

备注

Check Swelling on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.This argument is valid only when law = INPUT.
law=INPUT¶: A SymbolicConstant specifying the type of data defining the swelling behavior. Possible values are INPUT and USER. The default value is INPUT.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Swelling object.

返回类型:¶

Swelling

抛出:¶

RangeError --

UserMaterial( type=MECHANICAL, unsymm=0, mechanicalConstants=(), thermalConstants=(), effmod=0, hybridFormulation=INCREMENTAL, )[源代码]¶

This method creates a UserMaterial object.

备注

This function can be accessed by:

mdb.models[name].materials[name].UserMaterial
session.odbs[name].materials[name].UserMaterial

备注

Check UserMaterial on help.3ds.com/2017.

参数:¶

type=MECHANICAL¶: A SymbolicConstant specifying the type of material behavior defined by the command. Possible values are MECHANICAL, THERMAL, and THERMOMECHANICAL. The default value is MECHANICAL.
unsymm=0¶: A Boolean specifying if the material stiffness matrix, ∂Δσ/∂Δε, is not symmetric or, when a thermal constitutive model is used, if ∂f/∂(∂θ/∂x) is not symmetric. The default value is OFF. This argument is valid only for an Abaqus/Standard analysis.
mechanicalConstants=()¶: A sequence of Floats specifying the mechanical constants of the material. This argument is valid only when type = MECHANICAL or THERMOMECHANICAL. The default value is an empty sequence.
thermalConstants=()¶: A sequence of Floats specifying the thermal constants of the material. This argument is valid only when type = THERMAL or THERMOMECHANICAL. The default value is an empty sequence.
effmod=0¶: A Boolean specifying if effective bulk modulus and shear modulus are returned by user subroutine VUMAT. The default value is OFF. This argument is valid only in an Abaqus/Explicit analysis.
hybridFormulation=INCREMENTAL¶: A SymbolicConstant to specify the formulation of the hybrid element with user subroutine UMAT. Possible values are TOTAL, INCREMENTAL, and INCOMPRESSIBLE. The default value is INCREMENTAL. This argument is valid only in an Abaqus/Standard analysis.

返回:¶

A UserMaterial object.

返回类型:¶

UserMaterial

抛出:¶

RangeError --

UserOutputVariables(n=0)[源代码]¶

This method creates a UserOutputVariables object.

备注

This function can be accessed by:

mdb.models[name].materials[name].UserOutputVariables
session.odbs[name].materials[name].UserOutputVariables

备注

Check UserOutputVariables on help.3ds.com/2017.

参数:¶

n=0¶: An Int specifying the number of user-defined variables required at each material point. The default value is 0.

返回:¶

A UserOutputVariables object.

返回类型:¶

UserOutputVariables

抛出:¶

RangeError --

Viscoelastic( domain, table, frequency=FORMULA, type=ISOTROPIC, preload=NONE, time=PRONY, errtol=0, nmax=13, volumetricTable=(), )[源代码]¶

This method creates a Viscoelastic object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Viscoelastic
session.odbs[name].materials[name].Viscoelastic

备注

Check Viscoelastic on help.3ds.com/2017.

参数:¶

domain¶: A SymbolicConstant specifying the domain definition. Possible values are: - FREQUENCY, specifying a frequency domain. This domain is only available for an Abaqus/Standard analysis. - TIME, specifying a time domain.
table¶: A sequence of sequences of Floats specifying the items described below.
frequency=FORMULA¶: A SymbolicConstant specifying the frequency domain definition. This argument is required only when domain = FREQUENCY. Possible values are FORMULA, TABULAR, PRONY, CREEP_TEST_DATA, and RELAXATION_TEST_DATA. The default value is FORMULA.
type=ISOTROPIC¶: A SymbolicConstant specifying the type. This argument is required only when domain = FREQUENCY and frequency = TABULAR. Possible values are ISOTROPIC and TRACTION. The default value is ISOTROPIC.
preload=NONE¶: A SymbolicConstant specifying the preload. This argument is required only when domain = FREQUENCY and frequency = TABULAR. Possible values are NONE, UNIAXIAL, VOLUMETRIC, and UNIAXIAL_VOLUMETRIC. The default value is NONE.
time=PRONY¶: A SymbolicConstant specifying the time domain definition. This argument is required only when domain = TIME. Possible values are PRONY, CREEP_TEST_DATA, RELAXATION_TEST_DATA, and FREQUENCY_DATA. The default value is PRONY.
errtol=0¶: A Float specifying the allowable average root-mean-square error of the data points in the least-squares fit. The Float values correspond to percentages; for example, 0.01 is 1%. The default value is 0.01.This argument is valid only when time = CREEP_TEST_DATA, RELAXATION_TEST_DATA or FREQUENCY_DATA; or only when frequency = CREEP_TEST_DATA or RELAXATION_TEST_DATA.
nmax=13¶: An Int specifying the maximum number of terms NN in the Prony series. The maximum value is 13. The default value is 13.This argument is valid only when time = CREEP_TEST_DATA, RELAXATION_TEST_DATA or FREQUENCY_DATA; or only when frequency = CREEP_TEST_DATA or RELAXATION_TEST_DATA.
volumetricTable=()¶: A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.

返回:¶

A Viscoelastic object.

返回类型:¶

Viscoelastic

抛出:¶

RangeError --

Viscosity(table, type=NEWTONIAN, temperatureDependency=0, dependencies=0)[源代码]¶

This method creates a Viscosity object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Viscosity
session.odbs[name].materials[name].Viscosity

备注

Check Viscosity on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
type=NEWTONIAN¶: A SymbolicConstant specifying the type of viscosity. The default value is NEWTONIAN.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.

返回:¶

A Viscosity object.

返回类型:¶

Viscosity

抛出:¶

RangeError --

Viscous(table, law=STRAIN, temperatureDependency=0, dependencies=0, time=TOTAL)[源代码]¶

This method creates a Viscous object.

备注

This function can be accessed by:

mdb.models[name].materials[name].Viscous
session.odbs[name].materials[name].Viscous

备注

Check Viscous on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described below.
law=STRAIN¶: A SymbolicConstant specifying the creep law. Possible values are STRAIN, TIME and USER. The default value is STRAIN.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
time=TOTAL¶: A SymbolicConstant specifying the time interval for relevant laws. Possible values are CREEP and TOTAL. The default value is TOTAL.

返回:¶

A Viscous object.

返回类型:¶

Viscous

Other Classes¶

class AcousticMedium( acousticVolumetricDrag=0, temperatureDependencyB=0, temperatureDependencyV=0, dependenciesB=0, dependenciesV=0, bulkTable=(), volumetricTable=(), )[源代码]¶

基类：object

The AcousticMedium object specifies the acoustic properties of a material.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].acousticMedium
import odbMaterial
session.odbs[name].materials[name].acousticMedium

The corresponding analysis keywords are:

ACOUSTIC MEDIUM

备注

Check AcousticMedium on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the AcousticMedium object.

抛出:¶: RangeError --

class Density( table, temperatureDependency=0, dependencies=0, distributionType=UNIFORM, fieldName='', )[源代码]¶

基类：object

The Density object specifies the material density.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].density
import odbMaterial
session.odbs[name].materials[name].density

The table data for this object are:

The mass density.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

DENSITY

备注

Check Density on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Density object.

抛出:¶: RangeError --

class BiaxialTestData( table, smoothing=None, lateralNominalStrain=0, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The BiaxialTestData object provides equibiaxial test data (compression and/or tension).

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hyperelastic.biaxialTestData
mdb.models[name].materials[name].hyperfoam.biaxialTestData
mdb.models[name].materials[name].mullinsEffect.biaxialTests[i]
import odbMaterial
session.odbs[name].materials[name].hyperelastic.biaxialTestData
session.odbs[name].materials[name].hyperfoam.biaxialTestData
session.odbs[name].materials[name].mullinsEffect.biaxialTests[i]

The corresponding analysis keywords are:

BIAXIAL TEST DATA

备注

Check BiaxialTestData on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the BiaxialTestData object.

class Hyperfoam( testData=0, poisson=None, n=1, temperatureDependency=0, moduli=LONG_TERM, table=(), )[源代码]¶

基类：object

The Hyperfoam object specifies elastic properties for a hyperelastic foam.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hyperfoam
import odbMaterial
session.odbs[name].materials[name].hyperfoam

The table data for this object are: The items in the table data specify the following for values of nn:

\(\mu_i\) and \(\alpha_i\) for \(i\) from 1 to \(n\).
:math:nu_i`.
Temperature, if the data depend on temperature. Temperature dependence is not allowed for \(4\le n\le 6\) in an Abaqus/Explicit analysis.

The corresponding analysis keywords are:

HYPERFOAM

备注

Check Hyperfoam on help.3ds.com/2017.

Member Details:

biaxialTestData : --is-rst--:py:class:`~abaqus.Material.TestData.BiaxialTestData.BiaxialTestData` = <abaqus.Material.TestData.BiaxialTestData.BiaxialTestData object>[源代码]¶: A BiaxialTestData object.

planarTestData : --is-rst--:py:class:`~abaqus.Material.TestData.PlanarTestData.PlanarTestData` = <abaqus.Material.TestData.PlanarTestData.PlanarTestData object>[源代码]¶: A PlanarTestData object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Hyperfoam object.

抛出:¶: RangeError --

simpleShearTestData : --is-rst--:py:class:`~abaqus.Material.TestData.SimpleShearTestData.SimpleShearTestData` = <abaqus.Material.TestData.SimpleShearTestData.SimpleShearTestData object>[源代码]¶: A SimpleShearTestData object.

uniaxialTestData : --is-rst--:py:class:`~abaqus.Material.TestData.UniaxialTestData.UniaxialTestData` = <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>[源代码]¶: A UniaxialTestData object.

volumetricTestData : --is-rst--:py:class:`~abaqus.Material.TestData.VolumetricTestData.VolumetricTestData` = <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>[源代码]¶: A VolumetricTestData object.

class PlanarTestData( table, smoothing=None, lateralNominalStrain=0, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The PlanarTestData object specifies planar test (or pure shear) data (compression and/or tension).

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hyperelastic.planarTestData
mdb.models[name].materials[name].hyperfoam.planarTestData
mdb.models[name].materials[name].mullinsEffect.planarTests[i]
import odbMaterial
session.odbs[name].materials[name].hyperelastic.planarTestData
session.odbs[name].materials[name].hyperfoam.planarTestData
session.odbs[name].materials[name].mullinsEffect.planarTests[i]

The table data for this object are:

For a hyperelastic material model, the table data specify the following:
- Nominal stress, \(T_{S}\)
- Nominal strain in the direction of loading, \(\epsilon_{S}\).
For a hyperfoam material model, the table data specify the following:
- Nominal stress, \(T_{L}\).
- Nominal strain in the direction of loading, \(\epsilon_{p}\).
- Nominal transverse strain, \(\epsilon_{3}\). The default value is 0 .

The corresponding analysis keywords are:

PLANAR TEST DATA

备注

Check PlanarTestData on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the PlanarTestData object.

class SimpleShearTestData(table)[源代码]¶

基类：object

The SimpleShearTestData object provides simple shear test data.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hyperfoam.simpleShearTestData
import odbMaterial
session.odbs[name].materials[name].hyperfoam.simpleShearTestData

The table data for this object are:

Nominal shear stress, \(T_{S}\).
Nominal shear strain, \(\gamma\)
Nominal transverse stress, \(T_{T}\) (normal to edge with shear stress). This stress value is optional.

The corresponding analysis keywords are:

SIMPLE SHEAR TEST DATA

备注

Check SimpleShearTestData on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the SimpleShearTestData object.

class UniaxialTestData( table, smoothing=None, lateralNominalStrain=0, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The UniaxialTestData object provides uniaxial test data (compression and/or tension).

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hyperelastic.uniaxialTestData
mdb.models[name].materials[name].hyperfoam.uniaxialTestData
mdb.models[name].materials[name].lowDensityFoam.uniaxialCompressionTestData
mdb.models[name].materials[name].lowDensityFoam.uniaxialTensionTestData
mdb.models[name].materials[name].mullinsEffect.uniaxialTests[i]
import odbMaterial
session.odbs[name].materials[name].hyperelastic.uniaxialTestData
session.odbs[name].materials[name].hyperfoam.uniaxialTestData
session.odbs[name].materials[name].lowDensityFoam.uniaxialCompressionTestData
session.odbs[name].materials[name].lowDensityFoam.uniaxialTensionTestData
session.odbs[name].materials[name].mullinsEffect.uniaxialTests[i]

The table data for this object are:

For a hyperelastic material model, the table data specify the following:
- Nominal stress, \(T_{U}\).
- Nominal strain, \(\epsilon_{U}\).
For a hyperfoam material model, the table data specify the following:
- Nominal stress, \(T_{L}\).
- Nominal strain, \(\epsilon_{U}\).
- Nominal lateral strain, \(\epsilon_{2}=\epsilon_{3}\). The default value is 0 .
For a low-density foam material model, the table data specify the following:
- Nominal stress, \(T_{U}\).
- Nominal strain, \(\epsilon_{U}\).
- Nominal strain rate, \(\dot{\epsilon_{U}}\).

The corresponding analysis keywords are:

UNIAXIAL TEST DATA

备注

Check UniaxialTestData on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the UniaxialTestData object.

class VolumetricTestData( table, volinf=None, smoothing=None, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The VolumetricTestData object provides volumetric test data.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hyperelastic.volumetricTestData
mdb.models[name].materials[name].hyperfoam.volumetricTestData
mdb.models[name].materials[name].viscoelastic.volumetricTestData
import odbMaterial
session.odbs[name].materials[name].hyperelastic.volumetricTestData
session.odbs[name].materials[name].hyperfoam.volumetricTestData
session.odbs[name].materials[name].viscoelastic.volumetricTestData

The table data for this object are:

For a hyperelastic or hyperfoam material model, the table data specify the following:
- Pressure, \(p\).
- Volume ratio, \(J\) (current volume/original volume).
For a viscoelastic material model, the values depend on the value of the time member of the Viscoelastic object.
- If time = RELAXATION_TEST_DATA, the table data specify the following:
  Normalized volumetric (bulk) modulus \(k_{R}(t), \quad\left(0 \leq k_{R}(t) \leq 1\right)\)
  
  Time \(t (t>0)\).
- If time = CREEP_TEST_DATA, the table data specify the following:
  Normalized volumetric (bulk) compliance \(j_{K}(t), \quad\left(j_{K}(t) \geq 1\right)\).
  
  Time \(t(t>0)\)

The corresponding analysis keywords are:

VOLUMETRIC TEST DATA

备注

Check VolumetricTestData on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the VolumetricTestData object.

class Hyperelastic( table, type=UNKNOWN, moduliTimeScale=LONG_TERM, temperatureDependency=0, n=1, beta=FITTED_VALUE, testData=1, compressible=0, properties=0, deviatoricResponse=UNIAXIAL, volumetricResponse=DEFAULT, poissonRatio=0, materialType=ISOTROPIC, anisotropicType=FUNG_ANISOTROPIC, formulation=STRAIN, behaviorType=INCOMPRESSIBLE, dependencies=0, localDirections=0, )[源代码]¶

基类：object

The Hyperelastic object specifies elastic properties for approximately incompressible elastomers.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hyperelastic
import odbMaterial
session.odbs[name].materials[name].hyperelastic

The table data for this object are:

If type = ARRUDA_BOYCE, the table data specify the following:
- \(\mu\).
- \(\lambda_{m}\).
- \(D\).
- Temperature, if the data depend on temperature.
If type = MOONEY_RIVLIN, the table data specify the following:
- \(C_{10}\)
- \(C_{01}\).
- \(D_{1}\).
- Temperature, if the data depend on temperature.
If type = NEO_HOOKE, the table data specify the following:
- \(C_{10}\)
- \(D_{1}\).
- Temperature, if the data depend on temperature.
If type = OGDEN, the table data specify the following for values of nn:
- \(\mu_{i}\) and \(\alpha_{i}\) for \(i\) from 1 to \(n\).
- \(n\) coefficients \(D_{i}\).
- Temperature, if the data depend on temperature. Temperature dependence is not allowed for \(4 \leq n \leq 6\) in an Abaqus/Explicit analysis.
If type = POLYNOMIAL, the table data specify the following for values of nn:
- \(C_{i j}\) for each value of \((i+j)\) from 1 to \(n\) with \(i\) decreasing from \((i+j)\) to zero and \(j\) increasing from zero to \((i+j)\).
- \(n\) coefficients \(D_{i}\)
- Temperature, if the data depend on temperature. Temperature dependence is not allowed for \(3 \leq n \leq 6\) in an Abaqus/Explicit analysis.
If type = REDUCED_POLYNOMIAL, the table data specify the following for values of nn:
- \(C_{i 0}\) for \(i\) from 1 to \(n\).
- \(n\) coefficients \(D_{i}\)
- Temperature, if the data depend on temperature. Temperature dependence is not allowed for \(4 \leq n \leq 6\) in an Abaqus/Explicit analysis.
If type = VAN_DER_WAALS, the table data specify the following:
- \(\mu\).
- \(\lambda_{m}\).
- \(a\).
- \(\beta\).
- \(D\).
- Temperature, if the data depend on temperature.
If type = YEOH, the table data specify the following:
- \(C_{10}\)
- \(C_{20}\)
- \(C_{30}\)
- \(D_{1}\).
- \(D_{2}\)
- \(D_{3}\).
- Temperature, if the data depend on temperature. Temperature dependence is not allowed in an Abaqus/Explicit analysis.

The None object is the default value if testData = ON.

The corresponding analysis keywords are:

HYPERELASTIC

备注

Check Hyperelastic on help.3ds.com/2017.

Member Details:

biaxialTestData : --is-rst--:py:class:`~abaqus.Material.TestData.BiaxialTestData.BiaxialTestData` = <abaqus.Material.TestData.BiaxialTestData.BiaxialTestData object>[源代码]¶: A BiaxialTestData object.

hysteresis : --is-rst--:py:class:`~abaqus.Material.Elastic.HyperElastic.ViscoElastic.Hysteresis.Hysteresis` = <abaqus.Material.Elastic.HyperElastic.ViscoElastic.Hysteresis.Hysteresis object>[源代码]¶: A Hysteresis object.

planarTestData : --is-rst--:py:class:`~abaqus.Material.TestData.PlanarTestData.PlanarTestData` = <abaqus.Material.TestData.PlanarTestData.PlanarTestData object>[源代码]¶: A PlanarTestData object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Hyperelastic object.

抛出:¶: RangeError --

uniaxialTestData : --is-rst--:py:class:`~abaqus.Material.TestData.UniaxialTestData.UniaxialTestData` = <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>[源代码]¶: A UniaxialTestData object.

volumetricTestData : --is-rst--:py:class:`~abaqus.Material.TestData.VolumetricTestData.VolumetricTestData` = <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>[源代码]¶: A VolumetricTestData object.

class Hysteresis(table)[源代码]¶

基类：object

The Hysteresis object specifies the creep part of the material model for the hysteretic behavior of elastomers.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hyperelastic.hysteresis
import odbMaterial
session.odbs[name].materials[name].hyperelastic.hysteresis

The table data for this object are:

Stress scaling factor.
Creep parameter.
Effective stress exponent.
Creep strain exponent.

The corresponding analysis keywords are:

HYSTERESIS

备注

Check Hysteresis on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Hysteresis object.

抛出:¶: RangeError --

class CombinedTestData(table, volinf=None, shrinf=None)[源代码]¶

基类：object

The CombinedTestData object specifies simultaneously the normalized shear and bulk compliances or relaxation moduli as functions of time.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].viscoelastic.combinedTestData
import odbMaterial
session.odbs[name].materials[name].viscoelastic.combinedTestData

The table data for this object are:

If time = RELAXATION_TEST_DATA, the table data specify the following:

Normalized shear modulus, \(g_R(t)\) (\(0\le g_R(t)\le 1\)).
Normalized volumetric (bulk) modulus, \(k_R(t)\) (\(0\le k_R(t)\le 1\)).
Time \(t\) (\(t>0\)).

If time = CREEP_TEST_DATA, the table data specify the following:

Normalized shear compliance, \(j_S(t)\) (\(j_S(t)\ge 1\)).
Normalized volumetric (bulk) compliance, \(j_K(t)\) (\(j_K(t)\ge 1\)).
Time \(t\) (\(t>0\)).

The corresponding analysis keywords are:

COMBINED TEST DATA

备注

Check CombinedTestData on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the CombinedTestData object.

class ShearTestData(table, shrinf=None)[源代码]¶

基类：object

The ShearTestData object specifies the normalized shear creep compliance or relaxation modulus as a function of time.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].viscoelastic.shearTestData
import odbMaterial
session.odbs[name].materials[name].viscoelastic.shearTestData

The table data for this object are:

If time = RELAXATION_TEST_DATA, the table data specify the following:
- Normalized shear relaxation modulus \(g_{R}(t)\). \(\left(0 \leq g_{R}(t) \leq 1\right)\)
- Time \(t (t>0)\).
If time = CREEP_TEST_DATA, the table data specify the following:
- Normalized shear compliance \(j_{S}(t)\). \(\left(j_{S}(t) \geq 1\right)\).
- Time \(t (t>0)\).

The corresponding analysis keywords are:

SHEAR TEST DATA

备注

Check ShearTestData on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the ShearTestData object.

class Trs(definition=WLF, table=())[源代码]¶

基类：object

The Trs object defines the temperature-time shift for time history viscoelastic analysis.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].viscoelastic.trs
mdb.models[name].materials[name].viscosity.trs
import odbMaterial
session.odbs[name].materials[name].viscoelastic.trs
session.odbs[name].materials[name].viscosity.trs

The table data for this object are:

Reference temperature, \(\theta_{0}\).
Calibration constant, \(C_{1}\).
Calibration constant, \(C_{2}\).

The corresponding analysis keywords are:

备注

Check Trs on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the Trs object.

class Viscoelastic( domain, table, frequency=FORMULA, type=ISOTROPIC, preload=NONE, time=PRONY, errtol=0, nmax=13, volumetricTable=(), )[源代码]¶

基类：object

The Viscoelastic object specifies dissipative behavior for use with elasticity.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].viscoelastic
import odbMaterial
session.odbs[name].materials[name].viscoelastic

The table data for this object are:

If frequency = FORMULA, the table data for table specify the following:
- Real part of \(g_{1}^{*}\left(g^{*}(\omega)=g_{1}^{*} f^{-a}\right)\)
- Imaginary part of \(g_{1}^{*}\).
- Value of \(a\).
- Real part of \(k_{1}^{*}\left(k^{*}(\omega)=k_{1}^{*} f^{-b}\right)\). If the material is incompressible, this value is ignored.
- Imaginary part of \(k_{1}^{*}\). If the material is incompressible, this value is ignored.
- Value of \(b\). If the material is incompressible, this value is ignored.
If frequency = TABULAR and type = ISOTROPIC and preload = NONE, or time = FREQUENCY_DATA the table data for table specify the following:
- Real part of \(\omega g^{*}\left(\omega \Re\left(g^{*}\right)=G_{\ell} / G_{\infty}\right)\).
- Imaginary part of \(\omega g^{*}\left(\omega \mathfrak{J}\left(g^{*}\right)=1-G_{s} / G_{\infty}\right)\)
- Real part of \(\omega k^{*}\left(\omega \mathfrak{R}\left(k^{*}\right)=\mathrm{K}_{\ell} / \mathrm{K}_{\infty}\right)\). If the material is incompressible, this value is ignored.
- Imaginary part of \(\omega k^{*}\left(\omega \mathfrak{I}\left(k^{*}\right)=1-\mathrm{K}_{s} / \mathrm{K}_{\infty}\right)\). If the material is incompressible, this value is ignored.
- Frequency \(f\) in cycles per time.
If frequency = TABULAR and type = ISOTROPIC and preload = UNIAXIAL the table data for table specify the following:
- Loss modulus.
- Storage modulus.
- Frequency.
- Uniaxial strain.
If frequency = TABULAR and type = TRACTION and preload = NONE the table data for table specify the following:
- Normalized loss modulus.
- Normalized shear modulus.
- Frequency.
If frequency = TABULAR and type = TRACTION and preload = UNIAXIAL or preload = UNIAXIAL_VOLUMETRIC the table data for table specify the following:
- Loss modulus.
- Storage modulus.
- Frequency.
- Closure.
If time = PRONY or frequency = PRONY, the table data for table specify the following:
- \(\bar{g}_{1}^{P}\), the modulus ratio in the first term in the Prony series expansion of the shear relaxation modulus.
- \(\bar{k}_{1}^{P}\), the modulus ratio in the first term in the Prony series expansion of the bulk relaxation modulus.
- \(\tau_{1}\), the relaxation time for the first term in the Prony series expansion.
If frequency = TABULAR and type = ISOTROPIC and preload = VOLUMETRIC or preload = UNIAXIAL_VOLUMETRIC the table data for volumetricTable specify the following:
- Loss modulus.
- Storage modulus.
- Frequency.
- Volume ratio.

The corresponding analysis keywords are:

VISCOELASTIC

备注

Check Viscoelastic on help.3ds.com/2017.

Member Details:

combinedTestData : --is-rst--:py:class:`~abaqus.Material.Elastic.HyperElastic.ViscoElastic.CombinedTestData.CombinedTestData` = <abaqus.Material.Elastic.HyperElastic.ViscoElastic.CombinedTestData.CombinedTestData object>[源代码]¶: A CombinedTestData object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Viscoelastic object.

抛出:¶: RangeError --

shearTestData : --is-rst--:py:class:`~abaqus.Material.TestData.ShearTestData.ShearTestData` = <abaqus.Material.TestData.ShearTestData.ShearTestData object>[源代码]¶: A ShearTestData object.

trs : --is-rst--:py:class:`~abaqus.Material.Mechanical.Viscosity.Trs.Trs` = <abaqus.Material.Mechanical.Viscosity.Trs.Trs object>[源代码]¶: A Trs object.

volumetricTestData : --is-rst--:py:class:`~abaqus.Material.TestData.VolumetricTestData.VolumetricTestData` = <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>[源代码]¶: A VolumetricTestData object.

class Hypoelastic(table, user=0)[源代码]¶

基类：object

The Hypoelastic object specifies hypoelastic material properties.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].hypoelastic
import odbMaterial
session.odbs[name].materials[name].hypoelastic

The table data for this object are:

Instantaneous Young's modulus, \(E\).
Instantaneous Poisson's ratio, \(\nu\).
First strain invariant, \(I_1\).
Second strain invariant, \(I_2\).
Third strain invariant, \(I_3\).

The corresponding analysis keywords are:

HYPOELASTIC

备注

Check Hypoelastic on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the Hypoelastic object.

class Elastic( table, type=ISOTROPIC, noCompression=0, noTension=0, temperatureDependency=0, dependencies=0, moduli=LONG_TERM, )[源代码]¶

基类：object

The Elastic object specifies elastic material properties.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].elastic
import odbMaterial
session.odbs[name].materials[name].elastic

The table data for this object are:

If type = ISOTROPIC, the table data specify the following:
- The Young's modulus, \(E\).
- The Poisson's ratio, \(\nu\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = SHEAR, the table data specify the following:
- The shear modulus, \(G\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ENGINEERING_CONSTANTS, the table data specify the following:
- \(E_{1}\).
- \(E_{2}\).
- \(E_{3}\).
- \(\nu_{12}\).
- \(\nu_{13}\).
- \(\nu_{23}\).
- \(G_{12}\).
- \(G_{13}\).
- \(G_{23}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = LAMINA, the table data specify the following:
- \(E_{1}\).
- \(E_{2}\).
- \(\nu_{12}\).
- \(G_{12}\).
- \(G_{13}\). This shear modulus is needed to define transverse shear behavior in shells.
- \(G_{23}\). This shear modulus is needed to define transverse shear behavior in shells.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ORTHOTROPIC, the table data specify the following:
- \(D_{1111}\)
- \(D_{1122}\)
- \(D_{2222}\)
- \(D_{1133}\)
- \(D_{2233}\)
- \(D_{3333}\)
- \(D_{1212}\)
- \(D_{1313}\)
- \(D_{2323}\)
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ANISOTROPIC, the table data specify the following:
- \(D_{1111}\).
- \(D_{1122}\).
- \(D_{2222}\).
- \(D_{1133}\).
- \(D_{2233}\).
- \(D_{3333}\).
- \(D_{1112}\).
- \(D_{2212}\).
- \(D_{3312}\).
- \(D_{1212}\).
- \(D_{1113}\).
- \(D_{2213}\).
- \(D_{3313}\).
- \(D_{1213}\).
- \(D_{1313}\).
- \(D_{1123}\).
- \(D_{2223}\).
- \(D_{3323}\).
- \(D_{1223}\).
- \(D_{1323}\).
- \(D_{2323}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = TRACTION, the table data specify the following:
- \(E\) for warping elements; \(E_{nn}\) for cohesive elements.
- \(G_1\) for warping elements; \(E_{ss}\) for cohesive elements.
- \(G_2\) for warping elements; \(E_{tt}\) for cohesive elements.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = SHORT_FIBER, there is no table data.

The corresponding analysis keywords are:

ELASTIC

备注

Check Elastic on help.3ds.com/2017.

Member Details:

failStrain : --is-rst--:py:class:`~abaqus.Material.Elastic.Linear.FailStrain.FailStrain` = <abaqus.Material.Elastic.Linear.FailStrain.FailStrain object>[源代码]¶: A FailStrain object.

failStress : --is-rst--:py:class:`~abaqus.Material.Elastic.Linear.FailStress.FailStress` = <abaqus.Material.Elastic.Linear.FailStress.FailStress object>[源代码]¶: A FailStress object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Elastic object.

抛出:¶: RangeError --

class FailStrain(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The FailStrain object defines parameters for strain-based failure measures.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].elastic.failStrain
import odbMaterial
session.odbs[name].materials[name].elastic.failStrain

The table data for this object are:

Tensile strain limit in fiber direction, \(X_{\varepsilon t}\).
Compressive strain limit in fiber direction, \(X_{\varepsilon c}\).
Tensile strain limit in transverse direction, \(Y_{\varepsilon t}\),
Compressive strain limit in transverse direction, \(Y_{\varepsilon c}\).
Shear strain limit in the \(X - Y\) plane, \(S_{\varepsilon}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

FAIL STRAIN

备注

Check FailStrain on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the FailStrain object.

抛出:¶: RangeError --

class FailStress(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The FailStress object defines parameters for stress-based failure measures.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].elastic.failStress
import odbMaterial
session.odbs[name].materials[name].elastic.failStress

The table data for this object are:

Tensile stress limit in fiber direction, \(X_{t}\).
Compressive stress limit in fiber direction, \(X_{c}\).
Tensile stress limit in transverse direction, \(Y_{t}\)
Compressive stress limit in transverse direction, \(Y_{c}\).
Shear strength in the \(X - Y\) plane, \(S\).
Cross product term coefficient, \(f^{*} (-1.0 \leq f^{*} \leq 1.0)\). The default value is zero.
Biaxial stress limit, \(\sigma_{b i a x}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

FAIL STRESS

备注

Check FailStress on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the FailStress object.

抛出:¶: RangeError --

class LowDensityFoam( elementRemoval=0, maxAllowablePrincipalStress=None, extrapolateStressStrainCurve=0, strainRateType=VOLUMETRIC, mu0=None, mu1=0, alpha=2, )[源代码]¶

基类：object

The LowDensityFoam object specifies properties for low-density foam.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].lowDensityFoam
import odbMaterial
session.odbs[name].materials[name].lowDensityFoam

The corresponding analysis keywords are:

LOW DENSITY FOAM

备注

Check LowDensityFoam on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the LowDensityFoam object.

抛出:¶: RangeError --

uniaxialCompressionTestData : --is-rst--:py:class:`~abaqus.Material.TestData.UniaxialTestData.UniaxialTestData` = <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>[源代码]¶: A UniaxialTestData object.

uniaxialTensionTestData : --is-rst--:py:class:`~abaqus.Material.TestData.UniaxialTestData.UniaxialTestData` = <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>[源代码]¶: A UniaxialTestData object.

class PorousElastic(table, shear=POISSON, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The PorousElastic object specifies elastic material properties for porous materials.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].porousElastic
import odbMaterial
session.odbs[name].materials[name].porousElastic

The table data for this object are:

If shear = \(G\), the table data specify the following:
- The logarithmic bulk modulus, \(\kappa\). (Dimensionless.)
- The shear modulus, \(G\).
- The elastic tensile limit, \(p_{t}^{e l}\). (This value cannot be negative.)
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If shear = POISSON, the table data specify the following:
- The logarithmic bulk modulus, \(\kappa\). (Dimensionless.)
- The Poisson's ratio, \(\nu\).
- The elastic tensile limit, \(p_{t}^{e l}\). (This value cannot be negative.)
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

POROUS ELASTIC

备注

Check PorousElastic on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the PorousElastic object.

抛出:¶: RangeError --

class SuperElasticHardening(table)[源代码]¶

基类：object

The SuperElasticHardening object specifies the dependence of the yield stress on the total strain to define the piecewise linear hardening of a martensite material model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].superElasticity.SuperElasticHardening
import odbMaterial
session.odbs[name].materials[name].superElasticity.SuperElasticHardening

The table data for this object are:

Yield Stress.
Total Strain.

The corresponding analysis keywords are:

SUPERELASTIC HARDENING

备注

Check SuperElasticHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the SuperElasticHardening object.

抛出:¶: RangeError --

class SuperElasticHardeningModifications(table)[源代码]¶

基类：object

The SuperElasticHardeningModifications object specifies the variation of the transformation stress levels of a material model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].superElasticity.SuperElasticHardening
import odbMaterial
session.odbs[name].materials[name].superElasticity.SuperElasticHardening

The table data for this object are:

Start of Transformation (Loading).
End of Transformation (Loading).
Start of Transformation (Unloading).
End of Transformation (Unloading).
Plastic Strain.

The corresponding analysis keywords are:

SUPERELASTIC HARDENING MODIFICATIONS

备注

Check SuperElasticHardeningModifications on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the SuperElasticHardeningModifications object.

抛出:¶: RangeError --

class SuperElasticity(table, nonassociated=None)[源代码]¶

基类：object

The SuperElasticity object specifies a superelastic material model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].superElasticity
import odbMaterial
session.odbs[name].materials[name].superElasticity

The table data for this object are:

Young's Modulus (Martensite).
Poisson's Ratio (Martensite).
Transformation Strain.
Start of Transformation (Loading).
End of Transformation (Loading).
Start of Transformation (Unloading).
End of Transformation (Unloading).
Start of Transformation in Compression (Loading).
Reference Temperature.
Loading.
Unloading.

The corresponding analysis keywords are:

SUPERELASTIC

备注

Check SuperElasticity on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the SuperElasticity object.

抛出:¶: RangeError --

superElasticHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.SuperElastic.SuperElasticHardening.SuperElasticHardening` = <abaqus.Material.Plastic.SuperElastic.SuperElasticHardening.SuperElasticHardening object>[源代码]¶: A [SuperElasticHardening object](https://help.3ds.com/2022/english/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-superelastichardeningpyc.htm?ContextScope=all#simaker-c-superelastichardeningpyc).

superElasticHardeningModifications : --is-rst--:py:class:`~abaqus.Material.Plastic.SuperElastic.SuperElasticHardeningModifications.SuperElasticHardeningModifications` = <abaqus.Material.Plastic.SuperElastic.SuperElasticHardeningModifications.SuperElasticHardeningModifications object>[源代码]¶: A [SuperElasticHardeningModifications object](https://help.3ds.com/2022/english/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-superelastichardeningmodificationpyc.htm?ContextScope=all#simaker-c-superelastichardeningmodificationpyc).

class Dielectric( table, type=ISOTROPIC, frequencyDependency=0, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The Dielectric object specifies dielectric material properties.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].dielectric
import odbMaterial
session.odbs[name].materials[name].dielectric

The table data for this object are:

If type = ISOTROPIC, the table data specify the following:
- Dielectric constant.
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ORTHOTROPIC, the table data specify the following:
- \(D_{11}^{\varphi}\)
- \(D_{22}^{\varphi}\).
- \(D_{33}^{\varphi}\)
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ANISOTROPIC, the table data specify the following:
- \(D_{11}^{\varphi}\)
- \(D_{12}^{\varphi}\)
- \(D_{22}^{\varphi}\)
- \(D_{13}^{\varphi}\)
- \(D_{23}^{\varphi}\)
- \(D_{33}^{\varphi}\)
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

DIELECTRIC

备注

Check Dielectric on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the Dielectric object.

class ElectricalConductivity( table, type=ISOTROPIC, frequencyDependency=0, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The ElectricalConductivity object specifies electrical conductivity.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].electricalConductivity
import odbMaterial
session.odbs[name].materials[name].electricalConductivity

The table data for this object are:

If type = ISOTROPIC, the table data specify the following:
- Electrical conductivity.
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ORTHOTROPIC, the table data specify the following:
- \(\sigma_{11}^{E}\).
- \(\sigma_{22}^{E}\).
- \(\sigma_{33}^{E}\).
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ANISOTROPIC, the table data specify the following:
- \(\sigma_{11}^{E}\).
- \(\sigma_{12}^{E}\).
- \(\sigma_{22}^{E}\).
- \(\sigma_{13}^{E}\).
- \(\sigma_{23}^{E}\).
- \(\sigma_{33}^{E}\).
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

ELECTRICAL CONDUCTIVITY

备注

Check ElectricalConductivity on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the ElectricalConductivity object.

抛出:¶: RangeError --

class MagneticPermeability( table, table2, table3, type=ISOTROPIC, frequencyDependency=0, temperatureDependency=0, dependencies=0, nonlinearBH=0, )[源代码]¶

基类：object

The MagneticPermeability object specifies magnetic permeability.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].magneticPermeability
import odbMaterial
session.odbs[name].materials[name].magneticPermeability

The table data for this object are:

If type = ISOTROPIC, the table data specify the following:
- Magnetic permeability.
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ISOTROPIC, and nonlinearBH = TRUE, the table data specify the following:
- Magntitude of the magnetic flux density vector.
- Magnitude of the magnetic field vector.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ORTHOTROPIC, the table data specify the following:
- \(\mu_{11}^{E}\).
- \(\mu_{22}^{E}\).
- \(\mu_{33}^{E}\).
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ORTHOTROPIC, and nonlinearBH = TRUE, the table data specify the following:
- Magntitude of the magnetic flux density vector in the first direction.
- Magnitude of the magnetic field vector in the second direction.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ANISOTROPIC, the table data specify the following:
- \(\mu_{11}^{E}\).
- \(\mu_{12}^{E}\).
- \(\mu_{22}^{E}\).
- \(\mu_{13}^{E}\).
- \(\mu_{23}^{E}\).
- \(\mu_{33}^{E}\).
- Frequency, if the data depend on frequency.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

MAGNETIC PERMEABILITY

备注

Check MagneticPermeability on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the MagneticPermeability object.

抛出:¶: RangeError --

class Piezoelectric(table, type=STRESS, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Piezoelectric object specifies piezoelectric material properties.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].piezoelectric
import odbMaterial
session.odbs[name].materials[name].piezoelectric

The table data for this object are:

If type = STRESS, the table data specify the following:
- \(e_{111}^{\varphi}\).
- \(e_{122}^{\varphi}\).
- \(e_{133}^{\varphi}\).
- \(e_{112}^{\varphi}\).
- \(e_{113}^{\varphi}\).
- \(e_{123}^{\varphi}\).
- \(e_{211}^{\varphi}\).
- \(e_{222}^{\varphi}\).
- \(e_{233}^{\varphi}\).
- \(e_{212}^{\varphi}\).
- \(e_{213}^{\varphi}\).
- \(e_{223}^{\varphi}\).
- \(e_{311}^{\varphi}\).
- \(e_{322}^{\varphi}\).
- \(e_{333}^{\varphi}\).
- \(e_{312}^{\varphi}\).
- \(e_{313}^{\varphi}\).
- \(e_{323}^{\varphi}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = STRAIN, the table data specify the following:
- \(d_{111}^{\varphi}\).
- \(d_{122}^{\varphi}\).
- \(d_{133}^{\varphi}\).
- \(d_{112}^{\varphi}\).
- \(d_{113}^{\varphi}\).
- \(d_{123}^{\varphi}\).
- \(d_{211}^{\varphi}\).
- \(d_{222}^{\varphi}\).
- \(d_{233}^{\varphi}\).
- \(d_{212}^{\varphi}\).
- \(d_{213}^{\varphi}\).
- \(d_{223}^{\varphi}\).
- \(d_{311}^{\varphi}\).
- \(d_{322}^{\varphi}\).
- \(d_{333}^{\varphi}\).
- \(d_{313}^{\varphi}\).
- \(d_{323}^{\varphi}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

PIEZOELECTRIC

备注

Check Piezoelectric on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the Piezoelectric object.

class DetonationPoint(table)[源代码]¶

基类：object

A DetonationPoint object specifies a suboption of the Eos object. The DetonationPoint object defines either isotropic linear elastic shear or linear viscous shear behavior for a hydrodynamic material.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].eos.detonationPoint
import odbMaterial
session.odbs[name].materials[name].eos.detonationPoint

The table data for this object are:

X value for coordinate of detonation point.
Y value for coordinate of detonation point.
Z value for coordinate of detonation point.
Detonation delay time.

The corresponding analysis keywords are:

DETONATION POINT

备注

Check DetonationPoint on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the DetonationPoint object.

class Eos( type=IDEALGAS, temperatureDependency=0, dependencies=0, detonationEnergy=0, solidTable=(), gasTable=(), reactionTable=(), gasSpecificTable=(), table=(), )[源代码]¶

基类：object

The Eos object specifies an equation of state model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].eos
import odbMaterial
session.odbs[name].materials[name].eos

The table data for this object are:

If type = IDEALGAS, the table data represents the following:
- Gas constant, \(R\).
- The ambient pressure, \(p_{A}\). If this field is left blank, a default of 0.0 is used.
If type = JWL, the table data represents the following:
- Detonation wave speed, \(C_{d}\).
- \(A\).
- \(B\).
- \(\omega\). (Dimensionless.)
- \(R_{1}\). (Dimensionless.)
- \(R_{2}\). (Dimensionless.)
- Pre-detonation bulk modulus, \(K_{p d}\).
- Detonation energy density, \(E_{0}\).
If type = USUP, the table data represents the following:
- \(C_{0}\)
- \(\boldsymbol{S}\). (Dimensionless.)
- \(\Gamma_{0}\). (Dimensionless.)
If type = TABULAR, the table data represents the following:
- \(F_{1}\)
- \(F_{2}\)
- \(\varepsilon_{v o l}^{c}\). (Dimensionless.)

备注

Check Eos on help.3ds.com/2017.

Member Details:

class EosCompaction(soundSpeed, porosity, pressure, compactionPressure)[源代码]¶

基类：object

The EosCompaction object specifies material eos compaction.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].eos.eosCompaction
import odbMaterial
session.odbs[name].materials[name].eos.eosCompaction

The corresponding analysis keywords are:

EOS COMPACTION

备注

Check EosCompaction on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the EosCompaction object.

抛出:¶: RangeError --

class GapFlow(table, kmax=None, temperatureDependency=0, dependencies=0, type=NEWTONIAN)[源代码]¶

基类：object

The GapFlow object specifies tangential flow constitutive parameters for pore pressure cohesive elements.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].gapFlow
import odbMaterial
session.odbs[name].materials[name].gapFlow

The table data for this object are:

If type = NEWTONIAN the table data specify the following:
- Pore viscosity.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = POWER_LAW the table data specify the following:
- Consistency.
- Exponent.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

GAP FLOW

备注

Check GapFlow on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the GapFlow object.

class ContactArea(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

A ContactArea object specifies a suboption of gasket thickness behavior when variableUnits = FORCE on the GasketThicknessBehavior object. The ContactArea object defines the contact area or contact width versus closure curves to output an average pressure through variable CS11.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].gasketThicknessBehavior.contactArea
import odbMaterial
session.odbs[name].materials[name].gasketThicknessBehavior.contactArea

The table data for this object are:

Contact area or width; this value must be positive.
Closure; this value must be positive.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

GASKET CONTACT AREA

备注

Check ContactArea on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the ContactArea object.

class GasketMembraneElastic(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The GasketMembraneElastic object defines the elastic parameters for the membrane shear behavior of a gasket.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].gasketMembraneElastic
import odbMaterial
session.odbs[name].materials[name].gasketMembraneElastic

The table data for this object are:

Young's modulus, \(E\).
Poisson's ratio, \(\nu\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

GASKET ELASTICITY

备注

Check GasketMembraneElastic on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the GasketMembraneElastic object.

抛出:¶: RangeError --

class GasketThicknessBehavior( table, temperatureDependency=0, dependencies=0, tensileStiffnessFactor=None, type=ELASTIC_PLASTIC, unloadingDependencies=0, unloadingTemperatureDependency=0, variableUnits=STRESS, yieldOnset=0, yieldOnsetMethod=RELATIVE_SLOPE_DROP, unloadingTable=(), )[源代码]¶

基类：object

The GasketThicknessBehavior object defines the behavior in the thickness direction for a gasket.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].gasketThicknessBehavior
import odbMaterial
session.odbs[name].materials[name].gasketThicknessBehavior

The table data for this object are:

If variableUnits = STRESS, the loading table data specify the following:
- Pressure; this value must be positive.
- Closure; this value must be positive.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If variableUnits = FORCE, the loading table data specify the following:
- Force or force per unit length; this value must be positive.
- Closure; this value must be positive.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If variableUnits = STRESS and type = ELASTIC_PLASTIC, the unloadingTable data specify the following:
- Pressure; this value must be positive.
- Closure; this value must be positive.
- Plastic closure; this value must be positive.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If variableUnits = FORCE and type = ELASTIC_PLASTIC, the unloadingTable data specify the following:
- Pressure; this value must be positive.
- Closure; this value must be positive.
- Plastic closure; this value must be positive.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If variableUnits = STRESS and type = DAMAGE, the unloadingTable data specify the following:
- Pressure; this value must be positive.
- Closure; this value must be positive.
- Maximum closure reached while loading the gasket; this value must be positive.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If variableUnits = FORCE and type = DAMAGE, the unloadingTable data specify the following:
- Force or force per unit length; this value must be positive.
- Closure; this value must be positive.
- Maximum closure reached while loading the gasket; this value must be positive.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

GASKET THICKNESS BEHAVIOR

备注

Check GasketThicknessBehavior on help.3ds.com/2017.

Member Details:

contactArea : --is-rst--:py:class:`~abaqus.Material.Gasket.ContactArea.ContactArea` = <abaqus.Material.Gasket.ContactArea.ContactArea object>[源代码]¶: A ContactArea object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the GasketThicknessBehavior object.

抛出:¶: RangeError --

class GasketTransverseShearElastic( table, variableUnits=STRESS, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The GasketTransverseShearElastic object defines the elastic parameters for the transverse shear behavior of a gasket.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].gasketTransverseShearElastic
import odbMaterial
session.odbs[name].materials[name].gasketTransverseShearElastic

The table data for this object are:

Shear stiffness. (This value cannot be negative.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

GASKET ELASTICITY

备注

Check GasketTransverseShearElastic on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the GasketTransverseShearElastic object.

抛出:¶: RangeError --

class Conductivity(table, type=ISOTROPIC, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Conductivity object specifies thermal conductivity.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].conductivity
import odbMaterial
session.odbs[name].materials[name].conductivity

The table data for this object are:

If type = ISOTROPIC, the table data specify the following:
- Conductivity, \(k\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ORTHOTROPIC, the table data specify the following:
- \(k_{11}\)
- \(k_{22}\).
- \(k_{33}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ANISOTROPIC, the table data specify the following:
- \(k_{11}\).
- \(k_{12}\).
- \(k_{22}\).
- \(k_{13}\).
- \(k_{23}\).
- \(k_{33}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

CONDUCTIVITY

备注

Check Conductivity on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Conductivity object.

抛出:¶: RangeError --

class HeatGeneration[源代码]¶

基类：object

The HeatGeneration object includes volumetric heat generation in heat transfer analyses.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].heatGeneration
import odbMaterial
session.odbs[name].materials[name].heatGeneration

The corresponding analysis keywords are:

HEAT GENERATION

备注

Check HeatGeneration on help.3ds.com/2017.

Member Details:

class InelasticHeatFraction(fraction=0)[源代码]¶

基类：object

The InelasticHeatFraction object defines the fraction of the rate of inelastic dissipation that appears as a heat source.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].inelasticHeatFraction
import odbMaterial
session.odbs[name].materials[name].inelasticHeatFraction

The corresponding analysis keywords are:

INELASTIC HEAT FRACTION

备注

Check InelasticHeatFraction on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the InelasticHeatFraction object.

抛出:¶: RangeError --

class JouleHeatFraction(fraction=1)[源代码]¶

基类：object

The JouleHeatFraction object defines the fraction of electric energy released as heat.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].jouleHeatFraction
import odbMaterial
session.odbs[name].materials[name].jouleHeatFraction

The corresponding analysis keywords are:

JOULE HEAT FRACTION

备注

Check JouleHeatFraction on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the JouleHeatFraction object.

抛出:¶: RangeError --

class LatentHeat(table)[源代码]¶

基类：object

The LatentHeat object specifies a material's latent heat.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].latentHeat
import odbMaterial
session.odbs[name].materials[name].latentHeat

The table data for this object are:

Latent heat per unit mass.
Solidus temperature.
Liquidus temperature.

The corresponding analysis keywords are:

LATENT HEAT

备注

Check LatentHeat on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the LatentHeat object.

抛出:¶: RangeError --

class SpecificHeat(table, law=CONSTANTVOLUME, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The SpecificHeat object specifies a material's specific heat.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].specificHeat
import odbMaterial
session.odbs[name].materials[name].specificHeat

The table data for this object are:

Specific heat per unit mass.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

SPECIFIC HEAT

备注

Check SpecificHeat on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the SpecificHeat object.

抛出:¶: RangeError --

class Diffusivity(table, type=ISOTROPIC, law=GENERAL, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Diffusivity object specifies mass diffusivity.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].diffusivity
import odbMaterial
session.odbs[name].materials[name].diffusivity

The table data for this object are:

If type = ISOTROPIC, the table data specify the following:
- Diffusivity, \(D\).
- Concentration, \(c\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ORTHOTROPIC, the table data specify the following:
- \(D_{11}\).
- \(D_{22}\).
- \(D_{33}\).
- Concentration, \(c\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ANISOTROPIC, the table data specify the following:
- \(D_{11}\).
- \(D_{12}\).
- \(D_{22}\).
- \(D_{13}\).
- \(D_{23}\).
- \(D_{33}\).
- Concentration, \(c\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

DIFFUSIVITY

备注

Check Diffusivity on help.3ds.com/2017.

Member Details:

pressureEffect : --is-rst--:py:class:`~abaqus.Material.MassDiffusion.PressureEffect.PressureEffect` = <abaqus.Material.MassDiffusion.PressureEffect.PressureEffect object>[源代码]¶: A PressureEffect object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Diffusivity object.

抛出:¶: RangeError --

soretEffect : --is-rst--:py:class:`~abaqus.Material.MassDiffusion.SoretEffect.SoretEffect` = <abaqus.Material.MassDiffusion.SoretEffect.SoretEffect object>[源代码]¶: A SoretEffect object.

class PressureEffect(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The PressureEffect object defines equivalent pressure stress driven mass diffusion.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].diffusivity.pressureEffect
import odbMaterial
session.odbs[name].materials[name].diffusivity.pressureEffect

The table data for this object are:

Pressure stress factor, \(\kappa_p\).
Concentration.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

KAPPA

备注

Check PressureEffect on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the PressureEffect object.

抛出:¶: RangeError --

class SoretEffect(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The SoretEffect object defines temperature gradient driven mass diffusion.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].diffusivity.soretEffect
import odbMaterial
session.odbs[name].materials[name].diffusivity.soretEffect

The table data for this object are:

Soret effect factor, \(\kappa_s\).
Concentration.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

KAPPA

备注

Check SoretEffect on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the SoretEffect object.

抛出:¶: RangeError --

class Solubility(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Solubility object specifies solubility.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].solubility
import odbMaterial
session.odbs[name].materials[name].solubility

The table data for this object are:

Solubility.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

SOLUBILITY

备注

Check Solubility on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Solubility object.

抛出:¶: RangeError --

class BrittleCracking(table, temperatureDependency=0, dependencies=0, type=STRAIN)[源代码]¶

基类：object

The BrittleCracking object specifies cracking and postcracking properties for the brittle cracking material model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].brittleCracking
import odbMaterial
session.odbs[name].materials[name].brittleCracking

The table data for this object are:

If type = STRAIN the table data specify the following:
- Remaining direct stress after cracking.
- Direct cracking strain.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT the table data specify the following:
- Remaining direct stress after cracking.
- Direct cracking displacement.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = GFI the table data specify the following:
- Failure stress.
- Mode I fracture energy.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

BRITTLE CRACKING

备注

Check BrittleCracking on help.3ds.com/2017.

Member Details:

brittleFailure : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.BrittleFailure.BrittleFailure` = <abaqus.Material.Plastic.Concrete.BrittleFailure.BrittleFailure object>[源代码]¶: A BrittleFailure object.

brittleShear : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.BrittleShear.BrittleShear` = <abaqus.Material.Plastic.Concrete.BrittleShear.BrittleShear object>[源代码]¶: A BrittleShear object.

setValues(*args, **kwargs)[源代码]¶: This method modifies the BrittleCracking object.

class CapPlasticity(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The CapPlasticity object specifies the modified Drucker-Prager/Cap plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].capPlasticity
import odbMaterial
session.odbs[name].materials[name].capPlasticity

The table data for this object are:

Material cohesion, \(d\), in the \(p-t\) plane (Abaqus/Standard) or in the \(p-q\) plane (Abaqus/Explicit).
Material angle of friction, \(\beta\), in the \(p-t\) plane (Abaqus/Standard) or in the \(p-q\) plane (Abaqus/Explicit). Give the value in degrees.
Cap eccentricity parameter, \(R\). Its value must be greater than zero (typically \(0.0<R<1.0)\).
Initial cap yield surface position, \(\left.\varepsilon_{v o l}^{p l}\right|_{0}\)
Transition surface radius parameter, \(\alpha\). The default value is \(0.0\) (i.e., no transition surface). Abaqus/Standard assumes \(K=1.0\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CAP PLASTICITY

备注

Check CapPlasticity on help.3ds.com/2017.

Member Details:

capCreepCohesion : --is-rst--:py:class:`~abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepCohesion.CapCreepCohesion` = <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepCohesion.CapCreepCohesion object>[源代码]¶: A CapCreepCohesion object.

capCreepConsolidation : --is-rst--:py:class:`~abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepConsolidation.CapCreepConsolidation` = <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepConsolidation.CapCreepConsolidation object>[源代码]¶: A CapCreepConsolidation object.

capHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapHardening.CapHardening` = <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapHardening.CapHardening object>[源代码]¶: A CapHardening object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the CapPlasticity object.

抛出:¶: RangeError --

class CastIronPlasticity(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The CastIronPlasticity object specifies the Cast Iron plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].castIronPlasticity
import odbMaterial
session.odbs[name].materials[name].castIronPlasticity

The table data for this object are:

Plastic Poisson's ratio, \(\nu_{pl}\) (dimensionless).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CAST IRON PLASTICITY

备注

Check CastIronPlasticity on help.3ds.com/2017.

Member Details:

castIronCompressionHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.CastIron.CastIronCompressionHardening.CastIronCompressionHardening` = <abaqus.Material.Plastic.Metal.CastIron.CastIronCompressionHardening.CastIronCompressionHardening object>[源代码]¶: A CastIronCompressionHardening object.

castIronTensionHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.CastIron.CastIronTensionHardening.CastIronTensionHardening` = <abaqus.Material.Plastic.Metal.CastIron.CastIronTensionHardening.CastIronTensionHardening object>[源代码]¶: A CastIronTensionHardening object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the CastIronPlasticity object.

抛出:¶: RangeError --

class ClayPlasticity( table, intercept=None, hardening=EXPONENTIAL, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The ClayPlasticity object specifies the extended Cam-clay plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].clayPlasticity
import odbMaterial
session.odbs[name].materials[name].clayPlasticity

The table data for this object are:

If hardening = EXPONENTIAL, the table data specify the following:
- Logarithmic plastic bulk modulus, \(\lambda\) (dimensionless).
- Stress ratio at critical state, \(M\).
- The initial yield surface size, \(a_{0}\).
- \(\beta\), the parameter defining the size of the yield surface on the "wet" side of critical state.
- \(K\), the ratio of the flow stress in triaxial tension to the flow stress in triaxial compression. \(0.778 \leq K \leq 1.0\). If the default value of \(0.0\) is accepted, a value of \(1.0\) is assumed.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If hardening = TABULAR, the table data specify the following:
- Stress ratio at critical state, \(M\)
- The initial volumetric plastic strain, \(\left.\varepsilon_{\mathrm{vol}}^{p l}\right|_{0}\), corresponding to \(\left.p_{c}\right|_{0}\) according to the ClayHardening definition.
- \(\beta\), the parameter defining the size of the yield surface on the "wet" side of critical state.
- \(K\), the ratio of the flow stress in triaxial tension to the flow stress in triaxial compression. \(0.778 \leq K \leq 1.0\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

CLAY PLASTICITY

备注

Check ClayPlasticity on help.3ds.com/2017.

Member Details:

clayHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.CriticalStateClay.ClayHardening.ClayHardening` = <abaqus.Material.Plastic.CriticalStateClay.ClayHardening.ClayHardening object>[源代码]¶: A ClayHardening object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the ClayPlasticity object.

抛出:¶: RangeError --

class Concrete(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Concrete object defines concrete properties beyond the elastic range.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concrete
import odbMaterial
session.odbs[name].materials[name].concrete

The table data for this object are:

Absolute value of compressive stress.
Absolute value of Plastic strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CONCRETE

备注

Check Concrete on help.3ds.com/2017.

Member Details:

failureRatios : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.FailureRatios.FailureRatios` = <abaqus.Material.Plastic.Concrete.FailureRatios.FailureRatios object>[源代码]¶: A FailureRatios object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Concrete object.

抛出:¶: RangeError --

shearRetention : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.ShearRetention.ShearRetention` = <abaqus.Material.Plastic.Concrete.ShearRetention.ShearRetention object>[源代码]¶: A ShearRetention object.

tensionStiffening : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.TensionStiffening.TensionStiffening` = <abaqus.Material.Plastic.Concrete.TensionStiffening.TensionStiffening object>[源代码]¶: A TensionStiffening object.

class ConcreteDamagedPlasticity(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The ConcreteDamagedPlasticity object specifies the concrete damaged plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concreteDamagedPlasticity
import odbMaterial
session.odbs[name].materials[name].concreteDamagedPlasticity

The table data for this object are:

Dilation angle, \(\psi\) (in degrees) in the \(p - q\) plane.
Flow potential eccentricity, \(\epsilon\). The default value is 0.1.
\(\sigma_{b 0} / \sigma_{t 0}\), the ratio of initial equibiaxial compressive yield stress to initial uniaxial compressive yield stress. The default value is 1.16. stress is negative. The default value is 2/3. default value is 0.0.
\(K_c\), the ratio of the second stress invariant on the tensile meridian, to that on the compressive meridian, at initial yield for any given value of the pressure invariant \(p\) such that the maximum principal stress is negative. The default value is 2/3.
Viscosity parameter, \(\mu\), used for the viscoplastic regularization of the concrete constitutive equations in an Abaqus/Standard analysis. This parameter is ignored in an Abaqus/Explicit analysis. The default value is 0.0.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CONCRETE DAMAGED PLASTICITY

备注

Check ConcreteDamagedPlasticity on help.3ds.com/2017.

Member Details:

concreteCompressionDamage : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.ConcreteCompressionDamage.ConcreteCompressionDamage` = <abaqus.Material.Plastic.Concrete.ConcreteCompressionDamage.ConcreteCompressionDamage object>[源代码]¶: A ConcreteCompressionDamage object.

concreteCompressionHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.ConcreteCompressionHardening.ConcreteCompressionHardening` = <abaqus.Material.Plastic.Concrete.ConcreteCompressionHardening.ConcreteCompressionHardening object>[源代码]¶: A ConcreteCompressionHardening object.

concreteTensionDamage : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.ConcreteTensionDamage.ConcreteTensionDamage` = <abaqus.Material.Plastic.Concrete.ConcreteTensionDamage.ConcreteTensionDamage object>[源代码]¶: A ConcreteTensionDamage object.

concreteTensionStiffening : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.ConcreteTensionStiffening.ConcreteTensionStiffening` = <abaqus.Material.Plastic.Concrete.ConcreteTensionStiffening.ConcreteTensionStiffening object>[源代码]¶: A ConcreteTensionStiffening object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the ConcreteDamagedPlasticity object.

抛出:¶: RangeError --

class Creep(table, law=STRAIN, temperatureDependency=0, dependencies=0, time=TOTAL)[源代码]¶

基类：object

The Creep object defines a creep law.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].creep
import odbMaterial
session.odbs[name].materials[name].creep

The table data for this object are:

If law = STRAIN or law = TIME, the table data specify the following:
- \(A\).
- \(n\).
- \(m\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If law = HYPERBOLIC_SINE, the table data specify the following:
- \(A\).
- \(B\).
- \(n\).
- \(\triangle H\), if the data depend on temperature.
- \(R\)
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

CREEP

备注

Check Creep on help.3ds.com/2017.

Member Details:

ornl : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl` = <abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl object>[源代码]¶: An Ornl object.

potential : --is-rst--:py:class:`~abaqus.Material.Plastic.Potential.Potential` = <abaqus.Material.Plastic.Potential.Potential object>[源代码]¶: A Potential object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Creep object.

抛出:¶: RangeError --

class CrushableFoam(table, hardening=VOLUMETRIC, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The CrushableFoam object specifies the crushable foam plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].crushableFoam
import odbMaterial
session.odbs[name].materials[name].crushableFoam

The table data for this object are:

If hardening = VOLUMETRIC, the table data specify the following:
- Ratio, \(k\), of initial yield stress in uniaxial compression, \(\sigma_{c}^{0}\), to initial yield stress in hydrostatic compression, \(p_{c}^{0} ; 0.0<k<3.0\).
- Ratio, \(k_{t}\), of yield stress in hydrostatic tension, \(p_{t}\), to initial yield stress in hydrostatic compression, \(p_{c}^{0}\). The default value is \(1.0\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If hardening = ISOTROPIC, the table data specify the following:
- Ratio, \(k\), of initial yield stress in uniaxial compression, \(\sigma_{c}^{0}\), to initial yield stress in hydrostatic compression, \(p_{c}^{0}\); \(0.0 \leq k \leq 3.0\)
- Plastic Poisson's ratio. \(\nu_{p} ;-1 \leq \nu_{p} \leq 0.5\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

CRUSHABLE FOAM

备注

Check CrushableFoam on help.3ds.com/2017.

Member Details:

crushableFoamHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.CrushableFoam.CrushableFoamHardening.CrushableFoamHardening` = <abaqus.Material.Plastic.CrushableFoam.CrushableFoamHardening.CrushableFoamHardening object>[源代码]¶: A CrushableFoamHardening object.

rateDependent : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent` = <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>[源代码]¶: A RateDependent object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the CrushableFoam object.

抛出:¶: RangeError --

class DamageInitiation[源代码]¶

基类：object

The DamageInitiation object specifies material properties to define the initiation of damage.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].ductileDamageInitiation
mdb.models[name].materials[name].fldDamageInitiation
mdb.models[name].materials[name].flsdDamageInitiation
mdb.models[name].materials[name].hashinDamageInitiation
mdb.models[name].materials[name].johnsonCookDamageInitiation
mdb.models[name].materials[name].maxeDamageInitiation
mdb.models[name].materials[name].maxpeDamageInitiation
mdb.models[name].materials[name].maxpsDamageInitiation
mdb.models[name].materials[name].maxsDamageInitiation
mdb.models[name].materials[name].mkDamageInitiation
mdb.models[name].materials[name].msfldDamageInitiation
mdb.models[name].materials[name].quadeDamageInitiation
mdb.models[name].materials[name].quadsDamageInitiation
mdb.models[name].materials[name].shearDamageInitiation
import odbMaterial
session.odbs[name].materials[name].ductileDamageInitiation
session.odbs[name].materials[name].fldDamageInitiation
session.odbs[name].materials[name].flsdDamageInitiation
session.odbs[name].materials[name].hashinDamageInitiation
session.odbs[name].materials[name].johnsonCookDamageInitiation
session.odbs[name].materials[name].maxeDamageInitiation
session.odbs[name].materials[name].maxpeDamageInitiation
session.odbs[name].materials[name].maxpsDamageInitiation
session.odbs[name].materials[name].maxsDamageInitiation
session.odbs[name].materials[name].mkDamageInitiation
session.odbs[name].materials[name].msfldDamageInitiation
session.odbs[name].materials[name].quadeDamageInitiation
session.odbs[name].materials[name].quadsDamageInitiation
session.odbs[name].materials[name].shearDamageInitiation

The table data for this object are:

If constructor is DuctileDamageInitiation, the table data specify the following:
- Equivalent fracture strain at damage initiation.
- Stress triaxiality.
- Strain rate.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is FldDamageInitiation, the table data specify the following:
- Major principal strain at damage initiation.
- Minor principal strain.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor FlsdDamageInitiation, the table data specify the following:
- Major principal stress at damage initiation.
- Minor principal stress.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is JohnsonCookDamageInitiation, the table data specify the following:
- Johnson-Cook failure parameter D1.
- Johnson-Cook failure parameter D2.
- Johnson-Cook failure parameter D3.
- Johnson-Cook failure parameter D4.
- Johnson-Cook failure parameter D5.
- Melting temperature.
- Transition temperature.
- Reference strain rate.
If constructor MkDamageInitiation, the table data specify the following:
- Flaw size relative to nominal thickness of the section.
- Angle (in degrees) with respect to the 1-direction of the local material orientation.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is MsfldDamageInitiation and definition = MSFLD, the table data specify the following:
- Nominal strain at damage initiation in a normal-only mode.
- Equivalent Plastic strain at initiation of localized necking.
- Ratio of minor to major principal strains.
- Equivalent Plastic strain rate.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is MsfldDamageInitiation and definition = FLD, the table data specify the following:
- Major principal strain at initiation of localized necking.
- Equivalent Plastic strain at initiation of localized necking.
- Ratio of minor to major principal strains.
- Equivalent Plastic strain rate.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is QuadeDamageInitiation or MaxeDamageInitiation, the table data specify the following:
- Nominal strain at damage initiation in a normal-only mode.
- Nominal strain at damage initiation in a shear-only mode that involves separation only along the first shear direction.
- Nominal strain at damage initiation in a shear-only mode that involves separation only along the second shear direction.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is QuadsDamageInitiation or MaxsDamageInitiation, the table data specify the following:
- Nominal strain at damage initiation in a normal-only mode.
- Nominal strain at damage initiation in a shear-only mode that involves separation only along the first shear direction.
- Nominal strain at damage initiation in a shear-only mode that involves separation only along the second shear direction.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is MaxpeDamageInitiation, the table data specify the following:
- Maximum principal strain at damage initiation.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is MaxpsDamageInitiation, the table data specify the following:
- Maximum principal stress at damage initiation.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is ShearDamageInitiation, the table data specify the following:
- Equivalent fracture strain at damage initiation.
- Shear stress ratio.
- Strain rate.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If constructor is HashinDamageInitiation, the table data specify the following:
- Fiber tensile strength.
- Fiber compressive strength.
- Matrix tensile strength.
- Matrix compressive strength.
- Longitudinal shear strength.
- Transverse shear strength.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

DAMAGE INITIATION

备注

Check DamageInitiation on help.3ds.com/2017.

Member Details:

DamageEvolution( type, table, degradation=MAXIMUM, temperatureDependency=0, dependencies=0, mixedModeBehavior=MODE_INDEPENDENT, modeMixRatio=ENERGY, power=None, softening=LINEAR, )[源代码]¶

This method creates a DamageEvolution object.

备注

This function can be accessed by:

mdb.models[name].materials[name].ductileDamageInitiation.DamageEvolution
mdb.models[name].materials[name].fldDamageInitiation.DamageEvolution
mdb.models[name].materials[name].flsdDamageInitiation.DamageEvolution
mdb.models[name].materials[name].hashinDamageInitiation.DamageEvolution.DamageEvolutione].materials[name].johnsonCookDamageInitiation.DamageEvolution
mdb.models[name].materials[name].maxeDamageInitiation.DamageEvolution
mdb.models[name].materials[name].maxpeDamageInitiation.DamageEvolution
mdb.models[name].materials[name].maxpsDamageInitiation.DamageEvolution
mdb.models[name].materials[name].maxsDamageInitiation.DamageEvolution
mdb.models[name].materials[name].mkDamageInitiation.DamageEvolution
mdb.models[name].materials[name].msfldDamageInitiation.DamageEvolution
mdb.models[name].materials[name].quadeDamageInitiation.DamageEvolution
mdb.models[name].materials[name].quadsDamageInitiation.DamageEvolution
mdb.models[name].materials[name].shearDamageInitiation.DamageEvolution
session.odbs[name].materials[name].ductileDamageInitiation.DamageEvolution
session.odbs[name].materials[name].fldDamageInitiation.DamageEvolution
session.odbs[name].materials[name].flsdDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].hashinDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].johnsonCookDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].maxeDamageInitiation.DamageEvolution
session.odbs[name].materials[name].maxpeDamageInitiation.DamageEvolution
session.odbs[name].materials[name].maxpsDamageInitiation.DamageEvolution
session.odbs[name].materials[name].maxsDamageInitiation.DamageEvolution
session.odbs[name].materials[name].mkDamageInitiation.DamageEvolution
session.odbs[name].materials[name].msfldDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].quadeDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].quadsDamageInitiation.DamageEvolution
session.odbs[name].materials[name].shearDamageInitiation.DamageEvolution

备注

Check DamageEvolution on help.3ds.com/2017.

参数:¶

type¶: A SymbolicConstant specifying the type of damage evolution. Possible values are DISPLACEMENT and ENERGY.
table¶: A sequence of sequences of Floats specifying the items described below.
degradation=MAXIMUM¶: A SymbolicConstant specifying the degradation. Possible values are MAXIMUM and MULTIPLICATIVE. The default value is MAXIMUM.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
mixedModeBehavior=MODE_INDEPENDENT¶: A SymbolicConstant specifying the mixed mode behavior. Possible values are MODE_INDEPENDENT, TABULAR, POWER_LAW, and BK. The default value is MODE_INDEPENDENT.
modeMixRatio=ENERGY¶: A SymbolicConstant specifying the mode mix ratio. Possible values are ENERGY and TRACTION. The default value is ENERGY.
power=None¶: None or a Float specifying the exponent in the power law or the Benzeggagh-Kenane criterion that defines the variation of fracture energy with mode mix for cohesive elements. The default value is None.
softening=LINEAR¶: A SymbolicConstant specifying the softening. Possible values are LINEAR, EXPONENTIAL, and TABULAR. The default value is LINEAR.

返回:¶

A DamageEvolution object.

返回类型:¶

DamageEvolution

抛出:¶

RangeError --

DamageStabilizationCohesive(cohesiveCoeff=None)[源代码]¶

This method creates a DamageStabilizationCohesive object.

备注

This function can be accessed by:

mdb.models[name].materials[name].ductileDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].fldDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].flsdDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].hashinDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].johnsonCookDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].maxeDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].maxpeDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].maxpsDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].maxsDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].mkDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].msfldDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].quadeDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].quadsDamageInitiation.DamageStabilizationCohesive
mdb.models[name].materials[name].shearDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].ductileDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].fldDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].flsdDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].hashinDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].johnsonCookDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].maxeDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].maxpeDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].maxpsDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].maxsDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].mkDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].msfldDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].quadeDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].quadsDamageInitiation.DamageStabilizationCohesive
session.odbs[name].materials[name].shearDamageInitiation.DamageStabilizationCohesive

备注

Check DamageStabilizationCohesive on help.3ds.com/2017.

参数:¶

cohesiveCoeff=None¶: None or a Float specifying the viscosity coefficient. The default value is None.

返回:¶

A DamageStabilizationCohesive object.

返回类型:¶

DamageStabilizationCohesive

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].DuctileDamageInitiation
session.odbs[name].materials[name].DuctileDamageInitiation

备注

Check DuctileDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].FldDamageInitiation
session.odbs[name].materials[name].FldDamageInitiation

备注

Check FldDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].FlsdDamageInitiation
session.odbs[name].materials[name].FlsdDamageInitiation

备注

Check FlsdDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].HashinDamageInitiation
session.odbs[name].materials[name].HashinDamageInitiation

备注

Check HashinDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].JohnsonCookDamageInitiation
session.odbs[name].materials[name].JohnsonCookDamageInitiation

备注

Check JohnsonCookDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MaxeDamageInitiation
session.odbs[name].materials[name].MaxeDamageInitiation

备注

Check MaxeDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MaxpeDamageInitiation
session.odbs[name].materials[name].MaxpeDamageInitiation

备注

Check MaxpeDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MaxpsDamageInitiation
session.odbs[name].materials[name].MaxpsDamageInitiation

备注

Check MaxpsDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MaxsDamageInitiation
session.odbs[name].materials[name].MaxsDamageInitiation

备注

Check MaxsDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MkDamageInitiation
session.odbs[name].materials[name].MkDamageInitiation

备注

Check MkDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].MsfldDamageInitiation
session.odbs[name].materials[name].MsfldDamageInitiation

备注

Check MsfldDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].QuadeDamageInitiation
session.odbs[name].materials[name].QuadeDamageInitiation

备注

Check QuadeDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].QuadsDamageInitiation
session.odbs[name].materials[name].QuadsDamageInitiation

备注

Check QuadsDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
position=CENTROID¶: An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

This method creates A DamageInitiation object.

备注

This function can be accessed by:

mdb.models[name].materials[name].ShearDamageInitiation
session.odbs[name].materials[name].ShearDamageInitiation

备注

Check ShearDamageInitiation on help.3ds.com/2017.

参数:¶

table¶: A sequence of sequences of Floats specifying the items described in the "Table data" section.
definition=MSFLD¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
feq=10¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
fnn=10¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
fnt=10¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
frequency=1¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
ks=0¶: A Float specifying the value of Ks. The default value is 0.0.
numberImperfections=4¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
temperatureDependency=0¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.
dependencies=0¶: An Int specifying the number of field variable dependencies. The default value is 0.
alpha=0¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.
omega=1¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
tolerance=0¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.
direction=NMORI¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

返回:¶

A DamageInitiation object.

返回类型:¶

DamageInitiation

抛出:¶

RangeError --

alpha : --is-rst--:py:class:`float` = 0[源代码]¶: A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion. The default value is 0.0.

damageEvolution : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageEvolution.DamageEvolution` | :py:obj:`None` = None[源代码]¶: A DamageEvolution object.

damageStabilization : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageStabilization.DamageStabilization` | :py:obj:`None` = None[源代码]¶: A DamageStabilization object.

damageStabilizationCohesive : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageStabilizationCohesive.DamageStabilizationCohesive` = <abaqus.Material.ProgressiveDamageFailure.DamageStabilizationCohesive.DamageStabilizationCohesive object>[源代码]¶: A DamageStabilizationCohesive object.

definition : --is-rst--:py:class:`~abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant` = 'MSFLD'[源代码]¶: A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.

dependencies : --is-rst--:py:class:`int` = 0[源代码]¶: An Int specifying the number of field variable dependencies. The default value is 0.

direction : --is-rst--:py:class:`~abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant` = 'NMORI'[源代码]¶: A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.

feq : --is-rst--:py:class:`float` = 10[源代码]¶: A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.

fnn : --is-rst--:py:class:`float` = 10[源代码]¶: A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.

fnt : --is-rst--:py:class:`float` = 10[源代码]¶: A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.

frequency : --is-rst--:py:class:`int` = 1[源代码]¶: An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.

ks : --is-rst--:py:class:`float` = 0[源代码]¶: A Float specifying the value of Ks. The default value is 0.0.

numberImperfections : --is-rst--:py:class:`int` = 4[源代码]¶: An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.

omega : --is-rst--:py:class:`float` = 1[源代码]¶: A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.

setValues(*args, **kwargs)[源代码]¶: This method modifies the DamageInitiation object.

table : --is-rst--:py:class:`tuple`\ \[:py:class:`tuple`\ \[:py:class:`float`, :py:data:`...<Ellipsis>`], :py:data:`...<Ellipsis>`] = ()[源代码]¶: A tuple of tuples of Floats specifying the items described in the "Table data" section.

temperatureDependency : --is-rst--:py:data:`~typing.Union`\ \[:py:class:`~abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean`, :py:class:`bool`] = 0[源代码]¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.

tolerance : --is-rst--:py:class:`float` = 0[源代码]¶: A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.

class Damping(alpha=0, beta=0, composite=0, structural=0)[源代码]¶

基类：object

The Damping object specifies material damping.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].damping
import odbMaterial
session.odbs[name].materials[name].damping

The corresponding analysis keywords are:

DAMPING

备注

Check Damping on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Damping object.

抛出:¶: RangeError --

class DeformationPlasticity(table, temperatureDependency=0)[源代码]¶

基类：object

The DeformationPlasticity object specifies the deformation plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].deformationPlasticity
import odbMaterial
session.odbs[name].materials[name].deformationPlasticity

The table data for this object are:

Young's modulus, \(E\).
Poisson's ratio, \(\nu\).
Yield stress, \(\sigma^{0}\)
Exponent, \(n\).
Yield offset, \(\alpha\).
Temperature, if the data depend on temperature.

The corresponding analysis keywords are:

DEFORMATION PLASTICITY

备注

Check DeformationPlasticity on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the DeformationPlasticity object.

抛出:¶: RangeError --

class Depvar(deleteVar=0, n=0)[源代码]¶

基类：object

The Depvar object specifies solution-dependent state variables.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].depvar
import odbMaterial
session.odbs[name].materials[name].depvar

The corresponding analysis keywords are:

DEPVAR

备注

Check Depvar on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Depvar object.

抛出:¶: RangeError --

class DruckerPrager( table, shearCriterion=LINEAR, eccentricity=0, testData=0, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The DruckerPrager object specifies the extended Drucker-Prager plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].druckerPrager
import odbMaterial
session.odbs[name].materials[name].druckerPrager

The table data for this object are:

If shearCriterion = LINEAR (the only option allowed in an Abaqus/Explicit analysis), the table data specify the following:
- Material angle of friction, \(\beta\), in the \(p-t\) plane. Give the value in degrees.
- \(K\), the ratio of the flow stress in triaxial tension to the flow stress in triaxial compression. \(0.778 \leq K \leq 1.0\). If the default value of \(0.0\) is accepted, a value of \(1.0\) is assumed.
- Dilation angle, \(\psi\), in the \(p-t\) plane. Give the value in degrees.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If shearCriterion = HYPERBOLIC, the table data specify the following:
- Material angle of friction, \(\beta\), at high confining pressure in the \(p-q\) plane. Give the value in degrees.
- Initial hydrostatic tension strength, \(\left.p_{t}\right|_{0}\).
- Dilation angle, \(\psi\), at high confining pressure in the \(p-q\) plane. Give the value in degrees.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If shearCriterion = EXPONENTIAL, the table data specify the following:
- Dilation angle, \(\psi\), at high confining pressure in the \(p-q\) plane. Give the value in degrees.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

DRUCKER PRAGER

备注

Check DruckerPrager on help.3ds.com/2017.

Member Details:

druckerPragerCreep : --is-rst--:py:class:`~abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerCreep.DruckerPragerCreep` = <abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerCreep.DruckerPragerCreep object>[源代码]¶: A DruckerPragerCreep object.

druckerPragerHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerHardening.DruckerPragerHardening` = <abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerHardening.DruckerPragerHardening object>[源代码]¶: A DruckerPragerHardening object.

rateDependent : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent` = <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>[源代码]¶: A RateDependent object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the DruckerPrager object.

抛出:¶: RangeError --

triaxialTestData : --is-rst--:py:class:`~abaqus.Material.Plastic.DruckerPrager.Extended.TriaxialTestData.TriaxialTestData` = <abaqus.Material.Plastic.DruckerPrager.Extended.TriaxialTestData.TriaxialTestData object>[源代码]¶: A TriaxialTestData object.

class Expansion( type=ISOTROPIC, userSubroutine=0, zero=0, temperatureDependency=0, dependencies=0, table=(), )[源代码]¶

基类：object

The Expansion object specifies thermal expansion.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].expansion
import odbMaterial
session.odbs[name].materials[name].expansion

The table data for this object are:

If type = ISOTROPIC, the table data specify the following:
- \(\alpha\) in Abaqus/Standard or Abaqus/Explicit analysis.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ORTHOTROPIC, the table data specify the following:
- \(\alpha_{11}\).
- \(\alpha_{22}\).
- \(\alpha_{33}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ANISOTROPIC, the table data specify the following:
- \(\alpha_{11}\).
- \(\alpha_{22}\).
- \(\alpha_{33}\). (Not used for plane stress case.)
- \(\alpha_{12}\).
- \(\alpha_{13}\).
- \(\alpha_{23}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = SHORT_FIBER, there is no table data.

The corresponding analysis keywords are:

EXPANSION

备注

Check Expansion on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Expansion object.

抛出:¶: RangeError --

class FluidLeakoff(temperatureDependency=0, dependencies=0, type=COEFFICIENTS, table=())[源代码]¶

基类：object

The FluidLeakoff object specifies leak-off coefficients for pore pressure cohesive elements.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].fluidLeakoff
import odbMaterial
session.odbs[name].materials[name].fluidLeakoff

The table data for this object are:

The table data specify the following:

Fluid leak-off coefficient at top element surface.
Fluid leak-off coefficient at bottom element surface.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

FLUID LEAKOFF

备注

Check FluidLeakoff on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the FluidLeakoff object.

class Gel(table)[源代码]¶

基类：object

The Gel object defines a swelling gel.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].gel
import odbMaterial
session.odbs[name].materials[name].gel

The table data for this object are:

Radius of gel particles when completely dry, \(r_{a}^{\mathrm{dry}}\).
Fully swollen radius of gel particles, \(r_{a}^{f}\).
Number of gel particles per unit volume, \(k_{a}\).
Relaxation time constant for long-term swelling of gel particles, \(\tau_{1}\).

The corresponding analysis keywords are:

备注

Check Gel on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the Gel object.

class MaterialBase(name, description='', materialIdentifier='')[源代码]¶

基类：object

备注

This object can be accessed by:

import material
mdb.models[name].materials[name]
import odbMaterial
session.odbs[name].materials[name]

The corresponding analysis keywords are:

MATERIAL

备注

Check MaterialBase on help.3ds.com/2017.

Member Details:

acousticMedium : --is-rst--:py:class:`~abaqus.Material.Acoustic.AcousticMedium.AcousticMedium` = <abaqus.Material.Acoustic.AcousticMedium.AcousticMedium object>[源代码]¶: An AcousticMedium object.

brittleCracking : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.BrittleCracking.BrittleCracking` = <abaqus.Material.Plastic.Concrete.BrittleCracking.BrittleCracking object>[源代码]¶: A BrittleCracking object.

capPlasticity : --is-rst--:py:class:`~abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapPlasticity.CapPlasticity` = <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapPlasticity.CapPlasticity object>[源代码]¶: A CapPlasticity object.

castIronPlasticity : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.CastIron.CastIronPlasticity.CastIronPlasticity` = <abaqus.Material.Plastic.Metal.CastIron.CastIronPlasticity.CastIronPlasticity object>[源代码]¶: A CastIronPlasticity object.

clayPlasticity : --is-rst--:py:class:`~abaqus.Material.Plastic.CriticalStateClay.ClayPlasticity.ClayPlasticity` = <abaqus.Material.Plastic.CriticalStateClay.ClayPlasticity.ClayPlasticity object>[源代码]¶: A ClayPlasticity object.

concrete : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.Concrete.Concrete` = <abaqus.Material.Plastic.Concrete.Concrete.Concrete object>[源代码]¶: A Concrete object.

concreteDamagedPlasticity : --is-rst--:py:class:`~abaqus.Material.Plastic.Concrete.ConcreteDamagedPlasticity.ConcreteDamagedPlasticity` = <abaqus.Material.Plastic.Concrete.ConcreteDamagedPlasticity.ConcreteDamagedPlasticity object>[源代码]¶: A ConcreteDamagedPlasticity object.

conductivity : --is-rst--:py:class:`~abaqus.Material.HeatTransfer.Conductivity.Conductivity` = <abaqus.Material.HeatTransfer.Conductivity.Conductivity object>[源代码]¶: A Conductivity object.

creep : --is-rst--:py:class:`~abaqus.Material.Plastic.Creep.Creep.Creep` = <abaqus.Material.Plastic.Creep.Creep.Creep object>[源代码]¶: A Creep object.

crushableFoam : --is-rst--:py:class:`~abaqus.Material.Plastic.CrushableFoam.CrushableFoam.CrushableFoam` = <abaqus.Material.Plastic.CrushableFoam.CrushableFoam.CrushableFoam object>[源代码]¶: A CrushableFoam object.

damping : --is-rst--:py:class:`~abaqus.Material.Mechanical.Damping.Damping` = <abaqus.Material.Mechanical.Damping.Damping object>[源代码]¶: A Damping object.

deformationPlasticity : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.Deformation.DeformationPlasticity.DeformationPlasticity` = <abaqus.Material.Plastic.Metal.Deformation.DeformationPlasticity.DeformationPlasticity object>[源代码]¶: A DeformationPlasticity object.

density : --is-rst--:py:class:`~abaqus.Material.Density.Density.Density` = <abaqus.Material.Density.Density.Density object>[源代码]¶: A Density object.

depvar : --is-rst--:py:class:`~abaqus.Material.User.Depvar.Depvar` = <abaqus.Material.User.Depvar.Depvar object>[源代码]¶: A Depvar object.

dielectric : --is-rst--:py:class:`~abaqus.Material.Electromagnetic.Dielectric.Dielectric` = <abaqus.Material.Electromagnetic.Dielectric.Dielectric object>[源代码]¶: A Dielectric object.

diffusivity : --is-rst--:py:class:`~abaqus.Material.MassDiffusion.Diffusivity.Diffusivity` = <abaqus.Material.MassDiffusion.Diffusivity.Diffusivity object>[源代码]¶: A Diffusivity object.

druckerPrager : --is-rst--:py:class:`~abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPrager.DruckerPrager` = <abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPrager.DruckerPrager object>[源代码]¶: A DruckerPrager object.

ductileDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

elastic : --is-rst--:py:class:`~abaqus.Material.Elastic.Linear.Elastic.Elastic` = <abaqus.Material.Elastic.Linear.Elastic.Elastic object>[源代码]¶: An Elastic object.

electricalConductivity : --is-rst--:py:class:`~abaqus.Material.Electromagnetic.ElectricalConductivity.ElectricalConductivity` = <abaqus.Material.Electromagnetic.ElectricalConductivity.ElectricalConductivity object>[源代码]¶: An ElectricalConductivity object.

eos : --is-rst--:py:class:`~abaqus.Material.Eos.Eos.Eos` = <abaqus.Material.Eos.Eos.Eos object>[源代码]¶: An Eos object.

expansion : --is-rst--:py:class:`~abaqus.Material.Mechanical.Expansion.Expansion` = <abaqus.Material.Mechanical.Expansion.Expansion object>[源代码]¶: An Expansion object.

fldDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

flsdDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

fluidLeakoff : --is-rst--:py:class:`~abaqus.Material.PoreFluidFlow.FluidLeakoff.FluidLeakoff` = <abaqus.Material.PoreFluidFlow.FluidLeakoff.FluidLeakoff object>[源代码]¶: A FluidLeakoff object.

gapFlow : --is-rst--:py:class:`~abaqus.Material.Gap.GapFlow.GapFlow` = <abaqus.Material.Gap.GapFlow.GapFlow object>[源代码]¶: A GapFlow object.

gasketMembraneElastic : --is-rst--:py:class:`~abaqus.Material.Gasket.GasketMembraneElastic.GasketMembraneElastic` = <abaqus.Material.Gasket.GasketMembraneElastic.GasketMembraneElastic object>[源代码]¶: A GasketMembraneElastic object.

gasketThicknessBehavior : --is-rst--:py:class:`~abaqus.Material.Gasket.GasketThicknessBehavior.GasketThicknessBehavior` = <abaqus.Material.Gasket.GasketThicknessBehavior.GasketThicknessBehavior object>[源代码]¶: A GasketThicknessBehavior object.

gasketTransverseShearElastic : --is-rst--:py:class:`~abaqus.Material.Gasket.GasketTransverseShearElastic.GasketTransverseShearElastic` = <abaqus.Material.Gasket.GasketTransverseShearElastic.GasketTransverseShearElastic object>[源代码]¶: A GasketTransverseShearElastic object.

gel : --is-rst--:py:class:`~abaqus.Material.PoreFluidFlow.Gel.Gel` = <abaqus.Material.PoreFluidFlow.Gel.Gel object>[源代码]¶: A Gel object.

hashinDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

heatGeneration : --is-rst--:py:class:`~abaqus.Material.HeatTransfer.HeatGeneration.HeatGeneration` = <abaqus.Material.HeatTransfer.HeatGeneration.HeatGeneration object>[源代码]¶: A HeatGeneration object.

hyperelastic : --is-rst--:py:class:`~abaqus.Material.Elastic.HyperElastic.Hyperelastic.Hyperelastic` = <abaqus.Material.Elastic.HyperElastic.Hyperelastic.Hyperelastic object>[源代码]¶: A Hyperelastic object.

hyperfoam : --is-rst--:py:class:`~abaqus.Material.Elastic.HyperElastic.HyperFoam.Hyperfoam.Hyperfoam` = <abaqus.Material.Elastic.HyperElastic.HyperFoam.Hyperfoam.Hyperfoam object>[源代码]¶: A Hyperfoam object.

hypoelastic : --is-rst--:py:class:`~abaqus.Material.Elastic.HypoElastic.Hypoelastic.Hypoelastic` = <abaqus.Material.Elastic.HypoElastic.Hypoelastic.Hypoelastic object>[源代码]¶: A Hypoelastic object.

inelasticHeatFraction : --is-rst--:py:class:`~abaqus.Material.HeatTransfer.InelasticHeatFraction.InelasticHeatFraction` = <abaqus.Material.HeatTransfer.InelasticHeatFraction.InelasticHeatFraction object>[源代码]¶: An InelasticHeatFraction object.

johnsonCookDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

jouleHeatFraction : --is-rst--:py:class:`~abaqus.Material.HeatTransfer.JouleHeatFraction.JouleHeatFraction` = <abaqus.Material.HeatTransfer.JouleHeatFraction.JouleHeatFraction object>[源代码]¶: A JouleHeatFraction object.

latentHeat : --is-rst--:py:class:`~abaqus.Material.HeatTransfer.LatentHeat.LatentHeat` = <abaqus.Material.HeatTransfer.LatentHeat.LatentHeat object>[源代码]¶: A LatentHeat object.

lowDensityFoam : --is-rst--:py:class:`~abaqus.Material.Elastic.LowDensityFoam.LowDensityFoam.LowDensityFoam` = <abaqus.Material.Elastic.LowDensityFoam.LowDensityFoam.LowDensityFoam object>[源代码]¶: A LowDensityFoam object.

magneticPermeability : --is-rst--:py:class:`~abaqus.Material.Electromagnetic.MagneticPermeability.MagneticPermeability` = <abaqus.Material.Electromagnetic.MagneticPermeability.MagneticPermeability object>[源代码]¶: A MagneticPermeability object.

materialsFromOdb(fileName)[源代码]¶

This methods creates Material objects by reading an output database. The new materials are placed in the materials repository.

备注

This function can be accessed by:

mdb.models[name].Material
session.odbs[name].Material

备注

Check MaterialBase.materialsFromOdb on help.3ds.com/2017.

参数:¶

fileName¶: A String specifying the name of the output database file (including the .odb extension) to be read. This String can also be the full path to the output database file if it is located in another directory.

返回:¶

A list of Material objects.

返回类型:¶

list[Material]

maxeDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

maxpeDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

maxpsDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

maxsDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

mkDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

mohrCoulombPlasticity : --is-rst--:py:class:`~abaqus.Material.Plastic.MohrCoulomb.MohrCoulombPlasticity.MohrCoulombPlasticity` = <abaqus.Material.Plastic.MohrCoulomb.MohrCoulombPlasticity.MohrCoulombPlasticity object>[源代码]¶: A MohrCoulombPlasticity object.

moistureSwelling : --is-rst--:py:class:`~abaqus.Material.PoreFluidFlow.MoistureSwelling.MoistureSwelling.MoistureSwelling` = <abaqus.Material.PoreFluidFlow.MoistureSwelling.MoistureSwelling.MoistureSwelling object>[源代码]¶: A MoistureSwelling object.

msfldDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

mullinsEffect : --is-rst--:py:class:`~abaqus.Material.TestData.MullinsEffect.MullinsEffect` = <abaqus.Material.TestData.MullinsEffect.MullinsEffect object>[源代码]¶: A MullinsEffect object.

permeability : --is-rst--:py:class:`~abaqus.Material.PoreFluidFlow.Permeability.Permeability.Permeability` = <abaqus.Material.PoreFluidFlow.Permeability.Permeability.Permeability object>[源代码]¶: A Permeability object.

piezoelectric : --is-rst--:py:class:`~abaqus.Material.Electromagnetic.Piezoelectric.Piezoelectric` = <abaqus.Material.Electromagnetic.Piezoelectric.Piezoelectric object>[源代码]¶: A Piezoelectric object.

plastic : --is-rst--:py:class:`~abaqus.Material.Plastic.Plastic.Plastic` = <abaqus.Material.Plastic.Plastic.Plastic object>[源代码]¶: A Plastic object.

poreFluidExpansion : --is-rst--:py:class:`~abaqus.Material.Mechanical.PoreFluidExpansion.PoreFluidExpansion` = <abaqus.Material.Mechanical.PoreFluidExpansion.PoreFluidExpansion object>[源代码]¶: A PoreFluidExpansion object.

porousBulkModuli : --is-rst--:py:class:`~abaqus.Material.PoreFluidFlow.PorousBulkModuli.PorousBulkModuli` = <abaqus.Material.PoreFluidFlow.PorousBulkModuli.PorousBulkModuli object>[源代码]¶: A PorousBulkModuli object.

porousElastic : --is-rst--:py:class:`~abaqus.Material.Elastic.Porous.PorousElastic.PorousElastic` = <abaqus.Material.Elastic.Porous.PorousElastic.PorousElastic object>[源代码]¶: A PorousElastic object.

porousMetalPlasticity : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.Porous.PorousMetalPlasticity.PorousMetalPlasticity` = <abaqus.Material.Plastic.Metal.Porous.PorousMetalPlasticity.PorousMetalPlasticity object>[源代码]¶: A PorousMetalPlasticity object.

quadeDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

quadsDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

regularization : --is-rst--:py:class:`~abaqus.Material.Regularization.Regularization` = <abaqus.Material.Regularization.Regularization object>[源代码]¶: A Regularization object.

shearDamageInitiation : --is-rst--:py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = <abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation object>[源代码]¶: A DamageInitiation object.

solubility : --is-rst--:py:class:`~abaqus.Material.MassDiffusion.Solubility.Solubility` = <abaqus.Material.MassDiffusion.Solubility.Solubility object>[源代码]¶: A Solubility object.

sorption : --is-rst--:py:class:`~abaqus.Material.PoreFluidFlow.Sorption.Sorption` = <abaqus.Material.PoreFluidFlow.Sorption.Sorption object>[源代码]¶: A Sorption object.

specificHeat : --is-rst--:py:class:`~abaqus.Material.HeatTransfer.SpecificHeat.SpecificHeat` = <abaqus.Material.HeatTransfer.SpecificHeat.SpecificHeat object>[源代码]¶: A SpecificHeat object.

swelling : --is-rst--:py:class:`~abaqus.Material.Plastic.Swelling.Swelling.Swelling` = <abaqus.Material.Plastic.Swelling.Swelling.Swelling object>[源代码]¶: A Swelling object.

userDefinedField : --is-rst--:py:class:`~abaqus.Material.User.UserDefinedField.UserDefinedField` = <abaqus.Material.User.UserDefinedField.UserDefinedField object>[源代码]¶: A UserDefinedField object.

userMaterial : --is-rst--:py:class:`~abaqus.Material.User.UserMaterial.UserMaterial` = <abaqus.Material.User.UserMaterial.UserMaterial object>[源代码]¶: A UserMaterial object.

userOutputVariables : --is-rst--:py:class:`~abaqus.Material.User.UserOutputVariables.UserOutputVariables` = <abaqus.Material.User.UserOutputVariables.UserOutputVariables object>[源代码]¶: A UserOutputVariables object.

viscoelastic : --is-rst--:py:class:`~abaqus.Material.Elastic.HyperElastic.ViscoElastic.Viscoelastic.Viscoelastic` = <abaqus.Material.Elastic.HyperElastic.ViscoElastic.Viscoelastic.Viscoelastic object>[源代码]¶: A Viscoelastic object.

viscosity : --is-rst--:py:class:`~abaqus.Material.Mechanical.Viscosity.Viscosity.Viscosity` = <abaqus.Material.Mechanical.Viscosity.Viscosity.Viscosity object>[源代码]¶: A Viscosity object.

viscous : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.TwoLayerViscoPlasticity.Viscous.Viscous` = <abaqus.Material.Plastic.Metal.TwoLayerViscoPlasticity.Viscous.Viscous object>[源代码]¶: A Viscous object.

class MohrCoulombPlasticity( table, deviatoricEccentricity=None, meridionalEccentricity=0, temperatureDependency=0, dependencies=0, useTensionCutoff=0, )[源代码]¶

基类：object

The MohrCoulombPlasticity object specifies the extended Mohr-Coulomb plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].mohrCoulombPlasticity
import odbMaterial
session.odbs[name].materials[name].mohrCoulombPlasticity

The table data for this object are:

Friction angle (given in degrees), \(\phi\), at high confining pressure in the \(p-R_{m c} q\) plane.
Dilation angle, \(\psi\), at high confining pressure in the \(p-R_{m w} q\) plane.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

MOHR COULOMB

备注

Check MohrCoulombPlasticity on help.3ds.com/2017.

Member Details:

mohrCoulombHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.MohrCoulomb.MohrCoulombHardening.MohrCoulombHardening` = <abaqus.Material.Plastic.MohrCoulomb.MohrCoulombHardening.MohrCoulombHardening object>[源代码]¶: A MohrCoulombHardening object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the MohrCoulombPlasticity object.

抛出:¶: RangeError --

tensionCutOff : --is-rst--:py:class:`~abaqus.Material.Plastic.MohrCoulomb.TensionCutOff.TensionCutOff` = <abaqus.Material.Plastic.MohrCoulomb.TensionCutOff.TensionCutOff object>[源代码]¶: A TensionCutOff object.

class MoistureSwelling(table)[源代码]¶

基类：object

The MoistureSwelling object defines moisture-driven swelling.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].moistureSwelling
import odbMaterial
session.odbs[name].materials[name].moistureSwelling

The table data for this object are:

Volumetric moisture swelling strain, \(\varepsilon^{m s}\).
Saturation, \(s\). This value must lie in the range \(0.0 \leq s \leq 1.0\).

The corresponding analysis keywords are:

MOISTURE SWELLING

备注

Check MoistureSwelling on help.3ds.com/2017.

Member Details:

ratios : --is-rst--:py:class:`~abaqus.Material.Ratios.Ratios` = <abaqus.Material.Ratios.Ratios object>[源代码]¶: A Ratios object.

setValues(*args, **kwargs)[源代码]¶: This method modifies the MoistureSwelling object.

class Permeability( specificWeight, inertialDragCoefficient, table, type=ISOTROPIC, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The Permeability object defines permeability for pore fluid flow.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].permeability
import odbMaterial
session.odbs[name].materials[name].permeability

The table data for this object are:

If type = ISOTROPIC, the table data specify the following:
- \(k\).
- Void ratio, \(e\).
- Temperature, if the data depend on temperature.
If type = ORTHOTROPIC, the table data specify the following:
- \(k_{11}\).
- \(k_{22}\).
- \(k_{33}\).
- Void ratio, \(e\).
- Temperature, if the data depend on temperature.
If type = ANISOTROPIC, the table data specify the following:
- \(k_{11}\).
- \(k_{12}\).
- \(k_{22}\).
- \(k_{13}\).
- \(k_{23}\).
- \(k_{33}\).
- Void ratio, \(e\).
- Temperature, if the data depend on temperature.

The corresponding analysis keywords are:

PERMEABILITY

备注

Check Permeability on help.3ds.com/2017.

Member Details:

saturationDependence : --is-rst--:py:class:`~abaqus.Material.PoreFluidFlow.Permeability.SaturationDependence.SaturationDependence` = <abaqus.Material.PoreFluidFlow.Permeability.SaturationDependence.SaturationDependence object>[源代码]¶: A SaturationDependence object specifying the dependence of the permeability of a material on the saturation of the wetting liquid.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Permeability object.

抛出:¶: RangeError --

velocityDependence : --is-rst--:py:class:`~abaqus.Material.PoreFluidFlow.Permeability.VelocityDependence.VelocityDependence` = <abaqus.Material.PoreFluidFlow.Permeability.VelocityDependence.VelocityDependence object>[源代码]¶: A VelocityDependence object specifying the dependence of the permeability of a material on the velocity of fluid flow.

class Plastic( table, hardening=ISOTROPIC, rate=0, dataType=HALF_CYCLE, strainRangeDependency=0, numBackstresses=1, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The Plastic object specifies a metal plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].Plastic
import odbMaterial
session.odbs[name].materials[name].Plastic

The table data for this object are:

If hardening = ISOTROPIC, or if hardening = COMBINED and dataType = HALF_CYCLE, the table data specify the following:
- Yield stress.
- Plastic strain.
- Equivalent plastic strain rate, \(\dot{\bar{\varepsilon}} p l\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If hardening = COMBINED and dataType = STABILIZED, the table data specify the following:
- Yield stress.
- Plastic strain.
- Strain range, if the data depend on strain range.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If hardening = COMBINED and dataType = PARAMETERS, the table data specify the following:
- Yield stress at zero Plastic strain.
- The first kinematic hardening parameter, \(C_{1}\).
- The first kinematic hardening parameter, \(\gamma_{1}\).
- If applicable, the second kinematic hardening parameter, \(C_{2}\).
- If applicable, the second kinematic hardening parameter, \(\gamma_{2}\).
- Etc.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If hardening = KINEMATIC, the table data specify the following:
- Yield stress.
- Plastic strain.
- Temperature, if the data depend on temperature.
If hardening = JOHNSON_COOK, the table data specify the following:
- \(A\).
- \(B\).
- \(\mathrm{n}\).
- \(\mathrm{m}\).
- Melting temperature.
- Transition temperature.
If hardening = USER, the table data specify the following:
- Hardening properties.

The corresponding analysis keywords are:

PLASTIC

备注

Check Plastic on help.3ds.com/2017.

Member Details:

annealTemperature : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.Annealing.AnnealTemperature.AnnealTemperature` = <abaqus.Material.Plastic.Metal.Annealing.AnnealTemperature.AnnealTemperature object>[源代码]¶: An AnnealTemperature object.

cycledPlastic : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.Cyclic.CycledPlastic.CycledPlastic` = <abaqus.Material.Plastic.Metal.Cyclic.CycledPlastic.CycledPlastic object>[源代码]¶: A CycledPlastic object.

cyclicHardening : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.Cyclic.CyclicHardening.CyclicHardening` = <abaqus.Material.Plastic.Metal.Cyclic.CyclicHardening.CyclicHardening object>[源代码]¶: A CyclicHardening object.

ornl : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl` = <abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl object>[源代码]¶: An Ornl object.

potential : --is-rst--:py:class:`~abaqus.Material.Plastic.Potential.Potential` = <abaqus.Material.Plastic.Potential.Potential object>[源代码]¶: A Potential object.

rateDependent : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent` = <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>[源代码]¶: A RateDependent object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Plastic object.

抛出:¶: RangeError --

class PoreFluidExpansion(table, zero=0, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The PoreFluidExpansion object specifies the thermal expansion coefficient for a hydraulic fluid.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].poreFluidExpansion
import odbMaterial
session.odbs[name].materials[name].poreFluidExpansion

The table data for this object are:

Mean coefficient of thermal expansion, \(\theta_0\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

EXPANSION

备注

Check PoreFluidExpansion on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the PoreFluidExpansion object.

抛出:¶: RangeError --

class PorousBulkModuli(table, temperatureDependency=0)[源代码]¶

基类：object

The PorousBulkModuli object defines bulk moduli for soils and rocks.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].porousBulkModuli
import odbMaterial
session.odbs[name].materials[name].porousBulkModuli

The table data for this object are:

Bulk modulus of solid grains.
Bulk modulus of permeating fluid.
Temperature, if the data depend on temperature.

The corresponding analysis keywords are:

POROUS BULK MODULI

备注

Check PorousBulkModuli on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the PorousBulkModuli object.

class PorousMetalPlasticity( table, relativeDensity=None, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The PorousMetalPlasticity object specifies a porous metal plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].porousMetalPlasticity
import odbMaterial
session.odbs[name].materials[name].porousMetalPlasticity

The table data for this object are:

\(q_1\).
\(q_2\).
\(q_3\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

POROUS METAL PLASTICITY

备注

Check PorousMetalPlasticity on help.3ds.com/2017.

Member Details:

porousFailureCriteria : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.Porous.PorousFailureCriteria.PorousFailureCriteria` = <abaqus.Material.Plastic.Metal.Porous.PorousFailureCriteria.PorousFailureCriteria object>[源代码]¶: A PorousFailureCriteria object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the PorousMetalPlasticity object.

抛出:¶: RangeError --

voidNucleation : --is-rst--:py:class:`~abaqus.Material.Plastic.Metal.Porous.VoidNucleation.VoidNucleation` = <abaqus.Material.Plastic.Metal.Porous.VoidNucleation.VoidNucleation object>[源代码]¶: A VoidNucleation object.

class Regularization(rtol=0, strainRateRegularization=LOGARITHMIC)[源代码]¶

基类：object

The Regularization object defines the tolerance to be used for regularizing material data.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].regularization
import odbMaterial
session.odbs[name].materials[name].regularization

The corresponding analysis keywords are:

DASHPOT

备注

Check Regularization on help.3ds.com/2017.

Member Details:

rtol : --is-rst--:py:class:`float` = 0[源代码]¶: A Float specifying the tolerance to be used for regularizing material data. The default value is 0.03.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Regularization object.

抛出:¶: RangeError --

strainRateRegularization : --is-rst--:py:class:`~abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant` = 'LOGARITHMIC'[源代码]¶: A SymbolicConstant specifying the form of regularization of strain-rate-dependent material data. Possible values are LOGARITHMIC and LINEAR. The default value is LOGARITHMIC.

class Sorption( absorptionTable, lawAbsorption=TABULAR, exsorption=0, lawExsorption=TABULAR, scanning=0, exsorptionTable=(), )[源代码]¶

基类：object

The Sorption object defines absorption and exsorption behaviors of a partially saturated porous medium in the analysis of coupled wetting liquid flow and porous medium stress.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].sorption
import odbMaterial
session.odbs[name].materials[name].sorption

The table data for this object are:

If lawAbsorption = TABULAR or lawExsorption = TABULAR, the absorptionTable and exsorptionTable data respectively specify the following:
- Pore pressure, \(u_{w}\).
- Saturation, \(\boldsymbol{S}\).
If lawAbsorption = LOG or lawExsorption = LOG, the absorptionTable and exsorptionTable data respectively specify the following:
- \(A\).
- \(B\).
- \(\boldsymbol{s}_{0}\).
- \(\boldsymbol{s}_{1}\).

The corresponding analysis keywords are:

SORPTION

备注

Check Sorption on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Sorption object.

抛出:¶: RangeError --

class Swelling(table, law=INPUT, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Swelling object specifies time-dependent volumetric swelling for a material.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].swelling
import odbMaterial
session.odbs[name].materials[name].swelling

The table data for this object are:

Volumetric swelling strain rate.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

SWELLING

备注

Check Swelling on help.3ds.com/2017.

Member Details:

ratios : --is-rst--:py:class:`~abaqus.Material.Ratios.Ratios` = <abaqus.Material.Ratios.Ratios object>[源代码]¶: A Ratios object.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Swelling object.

抛出:¶: RangeError --

class UserMaterial( type=MECHANICAL, unsymm=0, mechanicalConstants=(), thermalConstants=(), effmod=0, hybridFormulation=INCREMENTAL, )[源代码]¶

基类：object

The UserMaterial object defines material constants for use in subroutines UMAT, UMATHT, or VUMAT.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].userMaterial
import odbMaterial
session.odbs[name].materials[name].userMaterial

The corresponding analysis keywords are:

USER MATERIAL

备注

Check UserMaterial on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the UserMaterial object.

抛出:¶: RangeError --

class UserOutputVariables(n=0)[源代码]¶

基类：object

The UserOutputVariables object specifies the number of user-defined output variables.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].userOutputVariables
import odbMaterial
session.odbs[name].materials[name].userOutputVariables

The corresponding analysis keywords are:

USER OUTPUT VARIABLES

备注

Check UserOutputVariables on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the UserOutputVariables object.

抛出:¶: RangeError --

class Viscosity(table, type=NEWTONIAN, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Viscosity object specifies mechanical viscosity.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].viscosity
import odbMaterial
session.odbs[name].materials[name].viscosity

The table data for this object are:

If type = NEWTONIAN, the table data specify the following:
Viscosity, \(k\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

VISCOSITY

备注

Check Viscosity on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Viscosity object.

抛出:¶: RangeError --

trs : --is-rst--:py:class:`~abaqus.Material.Mechanical.Viscosity.Trs.Trs` = <abaqus.Material.Mechanical.Viscosity.Trs.Trs object>[源代码]¶: A Trs object.

class Viscous(table, law=STRAIN, temperatureDependency=0, dependencies=0, time=TOTAL)[源代码]¶

基类：object

The Viscous object specifies the viscous properties for a two-layer viscoplastic material model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].viscous
import odbMaterial
session.odbs[name].materials[name].viscous

The table data for this object are:

If law = STRAIN or law = TIME, the table data specify the following:
- \(A\).
- \(n\).
- \(m\).
- \(f\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If law = USER, the table data specify the following:
- \(f\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

VISCOUS

备注

Check Viscous on help.3ds.com/2017.

Member Details:

potential : --is-rst--:py:class:`~abaqus.Material.Plastic.Potential.Potential` = <abaqus.Material.Plastic.Potential.Potential object>[源代码]¶: A Potential object.

setValues(*args, **kwargs)[源代码]¶: This method modifies the Viscous object.

class MullinsEffect[源代码]¶

基类：object

The MullinsEffect specifies properties for mullins data.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].mullinsEffect
import odbMaterial
session.odbs[name].materials[name].mullinsEffect

备注

Check MullinsEffect on help.3ds.com/2017.

Member Details:

biaxialTests : --is-rst--:py:class:`~typing.List`\ \[:py:class:`~abaqus.Material.TestData.BiaxialTestData.BiaxialTestData`] = [][源代码]¶: A BiaxialTestDataArray object.

definition : --is-rst--:py:class:`~abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant` = 'CONSTANTS'[源代码]¶: A SymbolicConstant specifying the method of specifying the data. Possible values are USER, CONSTANTS, and TEST_DATA. The default value is CONSTANTS.

dependencies : --is-rst--:py:class:`int` = 0[源代码]¶: An Int specifying the number of field variable dependencies. The default value is 0.

planarTests : --is-rst--:py:class:`~typing.List`\ \[:py:class:`~abaqus.Material.TestData.PlanarTestData.PlanarTestData`] = [][源代码]¶: A PlanarTestDataArray object.

properties : --is-rst--:py:class:`int` = 0[源代码]¶: An Int specifying the number of property values needed as data for the user-defined hyperelastic material. The default value is 0.

table : --is-rst--:py:class:`tuple`\ \[:py:class:`tuple`\ \[:py:class:`float`, :py:data:`...<Ellipsis>`], :py:data:`...<Ellipsis>`] = ()[源代码]¶: A tuple of tuples of Floats specifying the items described below. The default value is an empty sequence.

temperatureDependency : --is-rst--:py:data:`~typing.Union`\ \[:py:class:`~abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean`, :py:class:`bool`] = 0[源代码]¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.

uniaxialTests : --is-rst--:py:class:`~typing.List`\ \[:py:class:`~abaqus.Material.TestData.UniaxialTestData.UniaxialTestData`] = [][源代码]¶: A UniaxialTestDataArray object.

class UserDefinedField[源代码]¶

基类：object

The UserDefinedField object redefines field variables at a material point.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].userDefinedField
import odbMaterial
session.odbs[name].materials[name].userDefinedField

The corresponding analysis keywords are:

USER DEFINED FIELD

备注

Check UserDefinedField on help.3ds.com/2017.

Member Details:

class BrittleFailure( table, temperatureDependency=0, dependencies=0, failureCriteria=UNIDIRECTIONAL, )[源代码]¶

基类：object

The BrittleFailure object specifies the brittle failure of the material.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].brittleCracking.brittleFailure
import odbMaterial
session.odbs[name].materials[name].brittleCracking.brittleFailure

The table data for this object are:

If parent BrittleCracking member type = STRAIN the table data specify the following:
- Direct cracking failure strain.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If parent BrittleCracking member type = DISPLACEMENT or type = GFI the table data specify the following:
- Direct cracking failure displacement.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

BRITTLE FAILURE

备注

Check BrittleFailure on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the BrittleFailure object.

抛出:¶: RangeError --

class BrittleShear(table, temperatureDependency=0, dependencies=0, type=RETENTION_FACTOR)[源代码]¶

基类：object

The BrittleShear object specifies the postcracking shear behavior of a material used in a brittle cracking model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].brittleCracking.brittleShear
import odbMaterial
session.odbs[name].materials[name].brittleCracking.brittleShear

The table data for this object are:

If type = RETENTION_FACTOR the table data specify the following:
- Shear retention factor.
- Crack opening strain.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = POWER_LAW the table data specify the following:
- \(e\).
- \(p\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

BRITTLE SHEAR

备注

Check BrittleShear on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the BrittleShear object.

抛出:¶: RangeError --

class FailureRatios(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The FailureRatios object specifies the shape of the failure surface for a Concrete model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concrete.failureRatios
import odbMaterial
session.odbs[name].materials[name].concrete.failureRatios

The table data for this object are:

Ratio of the ultimate biaxial compressive stress to the uniaxial compressive ultimate stress. The default value is 1.16.
Absolute value of the ratio of the uniaxial tensile stress at failure to the uniaxial compressive stress at failure. The default value is 0.09.
Ratio of the magnitude of a principal component of Plastic strain at ultimate stress in biaxial compression to the Plastic strain at ultimate stress in uniaxial compression. The default value is 1.28.
Ratio of the tensile principal stress value at shear in plane stress, when the other nonzero principal stress component is at the ultimate compressive stress value, to the tensile cracking stress under uniaxial tension. The default value is 1/3.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

FAILURE RATIOS

备注

Check FailureRatios on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the FailureRatios object.

抛出:¶: RangeError --

class ShearRetention(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The ShearRetention object defines the reduction of the shear modulus associated with crack surfaces in a Concrete model as a function of the tensile strain across the crack.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concrete.shearRetention
import odbMaterial
session.odbs[name].materials[name].concrete.shearRetention

The table data for this object are:

\(\varrho^{\text {close }} for dry concrete. The default value is 1.0\)
\(\varepsilon^{\max }\) for dry concrete. The default value is a very large number (full shear retention).
\(\varrho^{\text {close }} for wet concrete. The default value is 1.0\)
\(\varepsilon^{\max }\) for wet concrete. The default value is a very large number (full shear retention).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

SHEAR RETENTION

备注

Check ShearRetention on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the ShearRetention object.

抛出:¶: RangeError --

class TensionStiffening(table, type=STRAIN, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The TensionStiffening object defines the retained tensile stress normal to a crack in a Concrete model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concrete.tensionStiffening
import odbMaterial
session.odbs[name].materials[name].concrete.tensionStiffening

The table data for this object are:

If type = STRAIN, the table data specify the following:
- Fraction of remaining stress to stress at cracking.
- Absolute value of the direct strain minus the direct strain at cracking.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT, the table data specify the following:
- Displacement, u0u0, at which a linear loss of strength after cracking gives zero stress.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

TENSION STIFFENING

备注

Check TensionStiffening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the TensionStiffening object.

抛出:¶: RangeError --

class ConcreteCompressionDamage( table, tensionRecovery=0, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The ConcreteCompressionDamage object specifies hardening for the concrete damaged plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concreteDamagedPlasticity.concreteCompressionDamage
import odbMaterial
session.odbs[name].materials[name].concreteDamagedPlasticity.concreteCompressionDamage

The table data for this object are:

Compressive damage variable, \(d_{c}\).
Inelastic (crushing) strain, \(\epsilon_{c}^{i n}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CONCRETE COMPRESSION DAMAGE

备注

Check ConcreteCompressionDamage on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the ConcreteCompressionDamage object.

抛出:¶: RangeError --

class ConcreteCompressionHardening(table, rate=0, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The ConcreteCompressionHardening object specifies hardening for the concrete damaged plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concreteDamagedPlasticity.concreteCompressionHardening
import odbMaterial
session.odbs[name].materials[name].concreteDamagedPlasticity.concreteCompressionHardening

The table data for this object are:

Yield stress in compression, \(\sigma_{c}\).
Inelastic (crushing) strain, \(\epsilon_{c}^{i n}\).
Inelastic (crushing) strain rate, \(\dot{\epsilon}_{c}^{i n}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CONCRETE COMPRESSION HARDENING

备注

Check ConcreteCompressionHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the ConcreteCompressionHardening object.

抛出:¶: RangeError --

class ConcreteTensionDamage( table, compressionRecovery=1, type=STRAIN, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The ConcreteTensionDamage object specifies hardening for the concrete damaged plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concreteDamagedPlasticity.concreteTensionDamage
import odbMaterial
session.odbs[name].materials[name].concreteDamagedPlasticity.concreteTensionDamage

The table data for this object are:

If type = STRAIN, the table data specify the following:
- Tensile damage variable, \(d_{t}\).
- Direct cracking strain, \(\epsilon_{t}^{c k}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT, the table data specify the following:
- Tensile damage variable, \(d_{t}\)
- Direct cracking displacement, \(u_{t}^{c k}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

CONCRETE TENSION DAMAGE

备注

Check ConcreteTensionDamage on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the ConcreteTensionDamage object.

抛出:¶: RangeError --

class ConcreteTensionStiffening( table, rate=0, type=STRAIN, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The ConcreteTensionStiffening object specifies hardening for the concrete damaged plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].concreteDamagedPlasticity.concreteTensionStiffening
import odbMaterial
session.odbs[name].materials[name].concreteDamagedPlasticity.concreteTensionStiffening

The table data for this object are:

If type = STRAIN, the table data specify the following:
- Remaining direct stress after cracking, \(\sigma_{t}\).
- Direct cracking strain, \(\epsilon_{t}^{c k}\).
- Direct cracking strain rate, \(\dot{\epsilon}_{t}^{c k}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT, the table data specify the following:
- Remaining direct stress after cracking, \(\sigma_{t}\).
- Direct cracking displacement, \(u_{t}^{c k}\).
- Direct cracking displacement rate, \(\dot{u}_{t}^{c k}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = GFI, the table data specify the following:
- Failure stress, \(\sigma_{t 0}\)
- Fracture energy, \(G_{f}\).
- Direct cracking displacement rate, \(\dot{u}_{t}^{c k}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

CONCRETE TENSION STIFFENING

备注

Check ConcreteTensionStiffening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the ConcreteTensionStiffening object.

抛出:¶: RangeError --

class Ornl(a=0, h=None, reset=0)[源代码]¶

基类：object

The Ornl object specifies the constitutive model developed by Oak Ridge National Laboratory.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].creep.ornl
mdb.models[name].materials[name].Plastic.ornl
import odbMaterial
session.odbs[name].materials[name].creep.ornl
session.odbs[name].materials[name].Plastic.ornl

The corresponding analysis keywords are:

ORNL

备注

Check Ornl on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Ornl object.

抛出:¶: RangeError --

class Potential(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Potential object defines an anisotropic yield/creep model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].creep.potential
mdb.models[name].materials[name].Plastic.potential
mdb.models[name].materials[name].viscous.potential
import odbMaterial
session.odbs[name].materials[name].creep.potential
session.odbs[name].materials[name].Plastic.potential
session.odbs[name].materials[name].viscous.potential

The table data for this object are:

\(R_{11}\).
\(R_{22}\).
\(R_{33}\).
\(R_{12}\).
\(R_{13}\).
\(R_{23}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

POTENTIAL

备注

Check Potential on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the Potential object.

抛出:¶: RangeError --

class ClayHardening(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The ClayHardening object specifies hardening for the clay plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].clayPlasticity.clayHardening
import odbMaterial
session.odbs[name].materials[name].clayPlasticity.clayHardening

The table data for this object are:

The hydrostatic pressure stress at yield, \(p_c\).
The absolute value of the corresponding volumetric Plastic strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CLAY HARDENING

备注

Check ClayHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the ClayHardening object.

抛出:¶: RangeError --

class CrushableFoamHardening(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The CrushableFoamHardening object specifies hardening for the crushable foam plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].crushableFoam.crushableFoamHardening
import odbMaterial
session.odbs[name].materials[name].crushableFoam.crushableFoamHardening

The table data for this object are:

The yield stress in uniaxial compression, \(\sigma_c\).
The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CRUSHABLE FOAM HARDENING

备注

Check CrushableFoamHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the CrushableFoamHardening object.

抛出:¶: RangeError --

class RateDependent(table, type=POWER_LAW, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The RateDependent object defines a rate-dependent viscoplastic model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].crushableFoam.rateDependent
mdb.models[name].materials[name].druckerPrager.rateDependent
mdb.models[name].materials[name].Plastic.rateDependent
import odbMaterial
session.odbs[name].materials[name].crushableFoam.rateDependent
session.odbs[name].materials[name].druckerPrager.rateDependent
session.odbs[name].materials[name].Plastic.rateDependent

The table data for this object are:

If type = POWER_LAW, the table data specify the following:
- \(D\).
- \(n\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = YIELD_RATIO, the table data specify the following:
- Yield stress ratio, \(R=\bar{\sigma} / \sigma^{0}\).
- Equivalent plastic strain rate, \(\dot{\bar{\varepsilon}}^{p l}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = JOHNSON_COOK, the table data specify the following:
- \(C\).
- \(\dot{\varepsilon}_{0}\).

The corresponding analysis keywords are:

RATE DEPENDENT

备注

Check RateDependent on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the RateDependent object.

抛出:¶: RangeError --

class DruckerPragerCreep(table, law=STRAIN, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The DruckerPragerCreep object specifies creep for Drucker-Prager plasticity models.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].druckerPrager.druckerPragerCreep
import odbMaterial
session.odbs[name].materials[name].druckerPrager.druckerPragerCreep

The table data for this object are:

If law = TIME or law = STRAIN, the table data specify the following:
- 1. (Units of \(\mathrm{F}^{-n} \mathrm{~L}^{2 n} \mathrm{~T}^{-1-m}\).)
- \(n\).
- \(m\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If law = SINGHM, the table data specify the following:
- 1. (Units of \(\mathrm{T}^{-1}\). )
- \(\alpha\). (Units of \(F^{-1} L^{2}\).)
- \(m\).
- \(t_{1} \cdot\) (Units of \(\mathrm{T}\).)
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

DRUCKER PRAGER CREEP

备注

Check DruckerPragerCreep on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the DruckerPragerCreep object.

抛出:¶: RangeError --

class DruckerPragerHardening( table, type=COMPRESSION, rate=0, temperatureDependency=0, dependencies=0, )[源代码]¶

基类：object

The DruckerPragerHardening object specifies hardening for Drucker-Prager plasticity models.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].druckerPrager.druckerPragerHardening
import odbMaterial
session.odbs[name].materials[name].druckerPrager.druckerPragerHardening

The table data for this object are:

Yield stress.
Absolute value of the corresponding plastic strain. (The first tabular value entered must always be zero.)
Equivalent plastic strain rate, \(\dot{\bar{\varepsilon}}{ }^{p l}\), for which this hardening curve applies.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

DRUCKER PRAGER HARDENING

备注

Check DruckerPragerHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the DruckerPragerHardening object.

抛出:¶: RangeError --

class TriaxialTestData(table, a=None, b=None, pt=None)[源代码]¶

基类：object

The TriaxialTestData object provides triaxial test data.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].druckerPrager.triaxialTestData
import odbMaterial
session.odbs[name].materials[name].druckerPrager.triaxialTestData

The table data for this object are:

Sign and magnitude of confining stress, \(\sigma_1=\sigma_2\).
Sign and magnitude of the stress in loading direction, \(\sigma_3\).

The corresponding analysis keywords are:

TRIAXIAL TEST DATA

备注

Check TriaxialTestData on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the TriaxialTestData object.

抛出:¶: RangeError --

class CapCreepCohesion(table, law=STRAIN, temperatureDependency=0, dependencies=0, time=TOTAL)[源代码]¶

基类：object

The CapCreepCohesion object specifies a cap creep model and material properties.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].capPlasticity.capCreepCohesion
import odbMaterial
session.odbs[name].materials[name].capPlasticity.capCreepCohesion

The table data for this object are:

If law = STRAIN or law = TIME, the table data specify the following:
- \(A\).
- \(n\).
- \(m\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If law = SINGHM, the table data specify the following:
- \(A\).
- \(\alpha\).
- \(m\).
- \(t_{1}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

CAP CREEP

备注

Check CapCreepCohesion on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the CapCreepCohesion object.

class CapCreepConsolidation( table, law=STRAIN, temperatureDependency=0, dependencies=0, time=TOTAL, )[源代码]¶

基类：object

The CapCreepConsolidation object specifies a cap creep model and material properties.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].capPlasticity.capCreepConsolidation
import odbMaterial
session.odbs[name].materials[name].capPlasticity.capCreepConsolidation

The table data for this object are:

If law = STRAIN or law = TIME, the table data specify the following:
- \(A\).
- \(n\).
- \(m\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If law = SINGHM, the table data specify the following:
- \(A\).
- \(\alpha\).
- \(m\).
- \(t_{1}\).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

CAP CREEP

备注

Check CapCreepConsolidation on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the CapCreepConsolidation object.

class CapHardening(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The CapHardening object specifies Drucker-Prager/Cap plasticity hardening.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].capPlasticity.capHardening
import odbMaterial
session.odbs[name].materials[name].capPlasticity.capHardening

The table data for this object are:

Hydrostatic pressure yield stress.
Absolute value of the corresponding volumetric inelastic strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CAP HARDENING

备注

Check CapHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the CapHardening object.

抛出:¶: RangeError --

class AnnealTemperature(table, dependencies=0)[源代码]¶

基类：object

The AnnealTemperature object specifies the material annealing temperature.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].Plastic.annealTemperature
import odbMaterial
session.odbs[name].materials[name].Plastic.annealTemperature

The table data for this object are:

The annealing temperature, \(\theta\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

ANNEAL TEMPERATURE

备注

Check AnnealTemperature on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the AnnealTemperature object.

抛出:¶: RangeError --

class CastIronCompressionHardening(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The CastIronCompressionHardening object specifies hardening for the Cast- Iron plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].castIronPlasticity.castIronCompressionHardening
import odbMaterial
session.odbs[name].materials[name].castIronPlasticity.castIronCompressionHardening

The table data for this object are:

Yield stress in compression, \(\sigma_c\).
The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CAST IRON COMPRESSION HARDENING

备注

Check CastIronCompressionHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the CastIronCompressionHardening object.

抛出:¶: RangeError --

class CastIronTensionHardening(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The CastIronTensionHardening object specifies hardening for the Cast- Iron plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].castIronPlasticity.castIronTensionHardening
import odbMaterial
session.odbs[name].materials[name].castIronPlasticity.castIronTensionHardening

The table data for this object are:

Yield stress in uniaxial tension, \(\sigma_t\).
The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CAST IRON TENSION HARDENING

备注

Check CastIronTensionHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the CastIronTensionHardening object.

抛出:¶: RangeError --

class CycledPlastic(table, temperatureDependency=0)[源代码]¶

基类：object

The CycledPlastic object specifies cycled yield stress data for the ORNL constitutive model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].Plastic.cycledPlastic
import odbMaterial
session.odbs[name].materials[name].Plastic.cycledPlastic

The table data for this object are:

Yield stress.
Plastic strain.
Temperature, if the data depend on temperature.

The corresponding analysis keywords are:

CYCLED PLASTIC

备注

Check CycledPlastic on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the CycledPlastic object.

class CyclicHardening(table, temperatureDependency=0, dependencies=0, parameters=0)[源代码]¶

基类：object

The CyclicHardening object defines the evolution of the elastic domain for the nonlinear isotropic/kinematic hardening model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].Plastic.cyclicHardening
import odbMaterial
session.odbs[name].materials[name].Plastic.cyclicHardening

The table data for this object are:

Equivalent stress.
\(Q_{\infty}\) (only if parameters = ON).
Hardening parameter (only if parameters = ON).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

CYCLIC HARDENING

备注

Check CyclicHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶: This method modifies the CyclicHardening object.

class PorousFailureCriteria(fraction=1, criticalFraction=1)[源代码]¶

基类：object

The PorousFailureCriteria object specifies the material failure criteria for a porous metal.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].porousMetalPlasticity.porousFailureCriteria
import odbMaterial
session.odbs[name].materials[name].porousMetalPlasticity.porousFailureCriteria

The corresponding analysis keywords are:

POROUS FAILURE CRITERIA

备注

Check PorousFailureCriteria on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the PorousFailureCriteria object.

抛出:¶: RangeError --

class VoidNucleation(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The VoidNucleation object defines the nucleation of voids in a porous material.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].porousMetalPlasticity.voidNucleation
import odbMaterial
session.odbs[name].materials[name].porousMetalPlasticity.voidNucleation

The table data for this object are:

\(\varepsilon_{N}\), the mean value of the nucleation-strain normal distribution.
\(s_{N}\), the standard deviation of the nucleation-strain normal distribution.
\(f_{N}\), the volume fraction of nucleating voids.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

VOID NUCLEATION

备注

Check VoidNucleation on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the VoidNucleation object.

抛出:¶: RangeError --

class MohrCoulombHardening(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The MohrCoulombHardening object specifies hardening for the Mohr-Coulomb plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].mohrCoulombPlasticity.mohrCoulombHardening
import odbMaterial
session.odbs[name].materials[name].mohrCoulombPlasticity.mohrCoulombHardening

The table data for this object are:

Cohesion yield stress.
The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

MOHR COULOMB HARDENING

备注

Check MohrCoulombHardening on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the MohrCoulombHardening object.

抛出:¶: RangeError --

class TensionCutOff(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The TensionCutOff object specifies tension cutoff for different material models for example the Mohr- Coulomb plasticity model.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].mohrCoulombPlasticity.tensionCutOff
import odbMaterial
session.odbs[name].materials[name].mohrCoulombPlasticity.tensionCutOff

The table data for this object are:

Tension cutoff stress.
The value of the corresponding tensile Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

TENSION CUTOFF

备注

Check TensionCutOff on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the TensionCutOff object.

抛出:¶: RangeError --

class Ratios(table, temperatureDependency=0, dependencies=0)[源代码]¶

基类：object

The Ratios object specifies ratios that define anisotropic swelling.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].moistureSwelling.ratios
mdb.models[name].materials[name].swelling.ratios
import odbMaterial
session.odbs[name].materials[name].moistureSwelling.ratios
session.odbs[name].materials[name].swelling.ratios

The table data for this object are:

r11.
r22.
r33.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.

The corresponding analysis keywords are:

RATIOS

备注

Check Ratios on help.3ds.com/2017.

Member Details:

dependencies : --is-rst--:py:class:`int` = 0[源代码]¶: An Int specifying the number of field variable dependencies. The default value is 0.

setValues(*args, **kwargs)[源代码]¶

This method modifies the Ratios object.

抛出:¶: RangeError --

table : --is-rst--:py:class:`tuple`\ \[:py:class:`tuple`\ \[:py:class:`float`, :py:data:`...<Ellipsis>`], :py:data:`...<Ellipsis>`] = ()[源代码]¶: A sequence of sequences of Floats specifying the items described below.

temperatureDependency : --is-rst--:py:data:`~typing.Union`\ \[:py:class:`~abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean`, :py:class:`bool`] = 0[源代码]¶: A Boolean specifying whether the data depend on temperature. The default value is OFF.

class SaturationDependence(table)[源代码]¶

基类：object

The SaturationDependence object specifies the dependence of the permeability of a material on the saturation of the wetting liquid.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].permeability.saturationDependence
import odbMaterial
session.odbs[name].materials[name].permeability.saturationDependence

The table data for this object are:

\(k_{s}\). (Dimensionless.)
Saturation, \(\boldsymbol{S}\). (Dimensionless.)

The corresponding analysis keywords are:

PERMEABILITY

备注

Check SaturationDependence on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the SaturationDependence object.

抛出:¶: RangeError --

class VelocityDependence(table)[源代码]¶

基类：object

The VelocityDependence object specifies the dependence of the permeability of a material on the velocity of fluid flow.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].permeability.velocityDependence
import odbMaterial
session.odbs[name].materials[name].permeability.velocityDependence

The table data for this object are:

\(\beta\). Only \(\beta>0.0\) is allowed.
Void ratio, \(e\).

The corresponding analysis keywords are:

PERMEABILITY

备注

Check VelocityDependence on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the VelocityDependence object.

抛出:¶: RangeError --

class DamageEvolution( type, table, degradation=MAXIMUM, temperatureDependency=0, dependencies=0, mixedModeBehavior=MODE_INDEPENDENT, modeMixRatio=ENERGY, power=None, softening=LINEAR, )[源代码]¶

基类：object

The DamageEvolution object specifies material properties to define the evolution of damage.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].ductileDamageInitiation.damageEvolution
mdb.models[name].materials[name].fldDamageInitiation.damageEvolution
mdb.models[name].materials[name].flsdDamageInitiation.damageEvolution
mdb.models[name].materials[name].hashinDamageInitiation.damageEvolution
mdb.models[name].materials[name].johnsonCookDamageInitiation.damageEvolution
mdb.models[name].materials[name].maxeDamageInitiation.damageEvolution
mdb.models[name].materials[name].maxpeDamageInitiation.damageEvolution
mdb.models[name].materials[name].maxpsDamageInitiation.damageEvolution
mdb.models[name].materials[name].maxsDamageInitiation.damageEvolution
mdb.models[name].materials[name].mkDamageInitiation.damageEvolution
mdb.models[name].materials[name].msfldDamageInitiation.damageEvolution
mdb.models[name].materials[name].quadeDamageInitiation.damageEvolution
mdb.models[name].materials[name].quadsDamageInitiation.damageEvolution
mdb.models[name].materials[name].shearDamageInitiation.damageEvolution
import odbMaterial
session.odbs[name].materials[name].ductileDamageInitiation.damageEvolution
session.odbs[name].materials[name].fldDamageInitiation.damageEvolution
session.odbs[name].materials[name].flsdDamageInitiation.damageEvolution
session.odbs[name].materials[name].hashinDamageInitiation.damageEvolution
session.odbs[name].materials[name].johnsonCookDamageInitiation.damageEvolution
session.odbs[name].materials[name].maxeDamageInitiation.damageEvolution
session.odbs[name].materials[name].maxpeDamageInitiation.damageEvolution
session.odbs[name].materials[name].maxpsDamageInitiation.damageEvolution
session.odbs[name].materials[name].maxsDamageInitiation.damageEvolution
session.odbs[name].materials[name].mkDamageInitiation.damageEvolution
session.odbs[name].materials[name].msfldDamageInitiation.damageEvolution
session.odbs[name].materials[name].quadeDamageInitiation.damageEvolution
session.odbs[name].materials[name].quadsDamageInitiation.damageEvolution
session.odbs[name].materials[name].shearDamageInitiation.damageEvolution

The table data for this object are:

If type = DISPLACEMENT, and softening = LINEAR, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
- Equivalent total or Plastic displacement at failure, measured from the time of damage initiation.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ENERGY, and softening = LINEAR, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
- Fracture energy.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT, and softening = LINEAR, and mixedModeBehavior = TABULAR, the table data specify the following:
- Total displacement at failure, measured from the time of damage initiation.
- Appropriate mode mix ratio.
- Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ENERGY, and softening = LINEAR, and mixedModeBehavior = TABULAR, the table data specify the following:
- Fracture energy.
- Appropriate mode mix ratio.
- Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT, and softening = EXPONENTIAL, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
- Equivalent total or Plastic displacement at failure, measured from the time of damage initiation.
- Exponential law parameter.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ENERGY, and softening = EXPONENTIAL, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
- Fracture energy.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT, and softening = EXPONENTIAL, and mixedModeBehavior = TABULAR, the table data specify the following:
- Total displacement at failure, measured from the time of damage initiation.
- Exponential law parameter.
- Appropriate mode mix ratio.
- Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ENERGY, and softening = EXPONENTIAL, and mixedModeBehavior = TABULAR, the table data specify the following:
- Fracture energy.
- Appropriate mode mix ratio.
- Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT, and softening = TABULAR, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
- Damage variable.
- Equivalent total or Plastic displacement, measured from the time of damage initiation.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = DISPLACEMENT, and softening = TABULAR, and mixedModeBehavior = TABULAR, the table data specify the following:
- Damage variable.
- Equivalent total or Plastic displacement, measured from the time of damage initiation.
- Appropriate mode mix ratio.
- Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ENERGY, and softening = LINEAR or EXPONENTIAL, and mixedModeBehavior = POWER_LAW or BK, the table data specify the following:
- Normal mode fracture energy.
- Shear mode fracture energy for failure in the first shear direction.
- Shear mode fracture energy for failure in the second shear direction.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.
If type = ENERGY, softening = LINEAR and constructor for DamageInitiation = HashinDamageInitiation, the table data specify the following:
- Fiber tensile fracture energy.
- Fiber compressive fracture energy.
- Matrix tensile fracture energy.
- Matrix compressive fracture energy.
- Temperature, if the data depend on temperature.
- Value of the first field variable, if the data depend on field variables.
- Value of the second field variable.
- Etc.

The corresponding analysis keywords are:

DAMAGE EVOLUTION

备注

Check DamageEvolution on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the DamageEvolution object.

抛出:¶: RangeError --

class DamageStabilization( fiberTensileCoeff, fiberCompressiveCoeff, matrixTensileCoeff, matrixCompressiveCoeff, )[源代码]¶

基类：object

The DamageStabilization object specifies the viscosity coefficients for the damage model for fiber- reinforced materials.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].ductileDamageInitiation.damageStabilization
mdb.models[name].materials[name].fldDamageInitiation.damageStabilization
mdb.models[name].materials[name].flsdDamageInitiation.damageStabilization
mdb.models[name].materials[name].hashinDamageInitiation.damageStabilization
mdb.models[name].materials[name].johnsonCookDamageInitiation.damageStabilization
mdb.models[name].materials[name].maxeDamageInitiation.damageStabilization
mdb.models[name].materials[name].maxpeDamageInitiation.damageStabilization
mdb.models[name].materials[name].maxpsDamageInitiation.damageStabilization
mdb.models[name].materials[name].maxsDamageInitiation.damageStabilization
mdb.models[name].materials[name].mkDamageInitiation.damageStabilization
mdb.models[name].materials[name].msfldDamageInitiation.damageStabilization
mdb.models[name].materials[name].quadeDamageInitiation.damageStabilization
mdb.models[name].materials[name].quadsDamageInitiation.damageStabilization
mdb.models[name].materials[name].shearDamageInitiation.damageStabilization
import odbMaterial
session.odbs[name].materials[name].ductileDamageInitiation.damageStabilization
session.odbs[name].materials[name].fldDamageInitiation.damageStabilization
session.odbs[name].materials[name].flsdDamageInitiation.damageStabilization
session.odbs[name].materials[name].hashinDamageInitiation.damageStabilization
session.odbs[name].materials[name].johnsonCookDamageInitiation.damageStabilization
session.odbs[name].materials[name].maxeDamageInitiation.damageStabilization
session.odbs[name].materials[name].maxpeDamageInitiation.damageStabilization
session.odbs[name].materials[name].maxpsDamageInitiation.damageStabilization
session.odbs[name].materials[name].maxsDamageInitiation.damageStabilization
session.odbs[name].materials[name].mkDamageInitiation.damageStabilization
session.odbs[name].materials[name].msfldDamageInitiation.damageStabilization
session.odbs[name].materials[name].quadeDamageInitiation.damageStabilization
session.odbs[name].materials[name].quadsDamageInitiation.damageStabilization
session.odbs[name].materials[name].shearDamageInitiation.damageStabilization

The corresponding analysis keywords are:

DAMAGE STABILIZATION

备注

Check DamageStabilization on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the DamageStabilization object.

抛出:¶: RangeError --

class DamageStabilizationCohesive(cohesiveCoeff=None)[源代码]¶

基类：object

The DamageStabilizationCohesive object specifies the viscosity coefficients for the damage model for surface-based cohesive behavior or enriched cohesive behavior.

备注

This object can be accessed by:

import material
mdb.models[name].materials[name].ductileDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].fldDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].flsdDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].hashinDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].johnsonCookDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].maxeDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].maxpeDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].maxpsDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].maxsDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].mkDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].msfldDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].quadeDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].quadsDamageInitiation.damageStabilizationCohesive
mdb.models[name].materials[name].shearDamageInitiation.damageStabilizationCohesive
import odbMaterial
session.odbs[name].materials[name].ductileDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].fldDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].flsdDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].hashinDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].johnsonCookDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].maxeDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].maxpeDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].maxpsDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].maxsDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].mkDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].msfldDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].quadeDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].quadsDamageInitiation.damageStabilizationCohesive
session.odbs[name].materials[name].shearDamageInitiation.damageStabilizationCohesive

The corresponding analysis keywords are:

DAMAGE STABILIZATION

备注

Check DamageStabilizationCohesive on help.3ds.com/2017.

Member Details:

setValues(*args, **kwargs)[源代码]¶

This method modifies the DamageStabilizationCohesive object.

抛出:¶: RangeError --

evaluateMaterial( material, simulationName, dataSource, strainEnergyPotentials, marlowData=None, marlowDataType=None, testDataTypes=None, uniaxialStrainRange=None, biaxialStrainRange=None, planarStrainRange=None, volumeRatioRange=None, simpleShearStrainRange=None, viscoDataSource=None, viscoTestDataTypes=None, relaxationTime=None, creepTime=None, )[源代码]¶

This method evaluates the behavior of a hyperelastic material under standard test conditions.

备注

This function can be accessed by:

evaluateMaterial

备注

Check evaluateMaterial.evaluateMaterial on help.3ds.com/2017.

参数:¶

material¶

A Material object.

simulationName¶

A String specifying the name to be used for the material evaluation simulation.

dataSource¶

A SymbolicConstant specifying whether test data or coefficients should be used for the material definition in the unit element tests. Possible values are TEST_DATA or COEFFICIENTS.

strainEnergyPotentials¶

A sequence of SymbolicConstants specifying for which material models the material is to be evaluated. Possible values are

POLY_N1
POLY_N2
POLY_N3
POLY_N4
POLY_N5
POLY_N6,
OGDEN_N1
OGDEN_N2
OGDEN_N3
OGDEN_N4
OGDEN_N5
OGDEN_N6
REDUCED_POLY_N1,
REDUCED_POLY_N2
REDUCED_POLY_N3
REDUCED_POLY_N4
REDUCED_POLY_N5
REDUCED_POLY_N6,
ARRUDA_BOYCE
VAN_DER_WAALS
YEOH
MOONEY_RIVLIN
NEO_HOOKE.

Note: The options POLY_N3, POLY_N4, POLY_N5, and POLY_N6 are valid only if the material was defined by providing coefficients of the strain energy potential.

marlowData=None¶

None or a sequence of SymbolicConstants specifying the types of test data to be included in the material definition of the Marlow material that is being evaluated. Possible values are UNIAXIAL, BIAXIAL, PLANAR, or VOLUMETRIC. The default value is None.

marlowDataType=None¶

None or a SymbolicConstant specifying the input data type for the Marlow material model. Possible values are TENSION, COMPRESSION, or BOTH.

testDataTypes=None¶

A sequence of SymbolicConstants specifying the types of test data to be included in the material definition of the material being evaluated. Possible values are UNIAXIAL, BIAXIAL, PLANAR, and VOLUMETRIC.

uniaxialStrainRange=None¶

A tuple of Floats specifying minimum and maximum nominal strains to be applied in the uniaxial tension test.

biaxialStrainRange=None¶

A tuple of Floats specifying the minimum and maximum nominal strains to be applied in the biaxial tension test.

planarStrainRange=None¶

A tuple of Floats specifying the minimum and maximum nominal strains to be applied in the planar test. The planar test is equivalent to a pure shear test.

volumeRatioRange=None¶

A tuple of Floats specifying the minimum and maximum compressive volume ratio.

simpleShearStrainRange=None¶

A tuple of Floats specifying the minimum and maximum nominal strains to be applied in the simple shear test.

viscoDataSource=None¶

None or a SymbolicConstant specifying whether test data or coefficients should be used for the viscoelastic material definition in the element tests. Possible values are TEST_DATA or COEFFICIENTS. The default value is None.

viscoTestDataTypes=None¶

None or a sequence of SymbolicConstants specifying the types of test data to be included in the material definition of the viscoelastic material being evaluated. Possible values are UNIAXIAL, BIAXIAL, PLANAR, or VOLUMETRIC. The default value is None.

relaxationTime=None¶

None or a Float specifying the time period for the stress relaxation response mode. The default value is None.

creepTime=None¶

None or a Float specifying the time period for the creep response mode. The default value is None.

抛出:¶

MaterialEvaluationError -- If dataSource = TEST_DATA and strainEnergyPotentials contains POLY_N3, POLY_N4, POLY_N5, or POLY_N6.
MaterialEvaluationError -- If the material evaluation failed.
MaterialEvaluationError -- If the material type of the material to be evaluated is not hyperelastic.